Projectile aerodynamic characteristic calculation method based on rainstorm environment

By introducing three-dimensional modeling of heavy rain environment and bidirectional momentum coupling in projectile aerodynamic characteristics calculation, the problem of complexity of aerodynamic characteristics calculation under the influence of heavy rain is solved, and efficient and accurate aerodynamic characteristics simulation is achieved, which is suitable for different The two-phase gas-liquid flow simulation under operating conditions reduces the development cost and time.

CN119026503APending Publication Date: 2024-11-26JIANGSU UNIV OF SCI & TECH
View PDF 0 Cites 2 Cited by

Patent Information

Application Number
CN202411098250.3
Authority / Receiving Office
CN · China
Patent Type
Applications(China)
Current Assignee / Owner
Filing Date
2024-08-12
Publication Date
2024-11-26

AI Technical Summary

Technical Problem

When studying the aerodynamic characteristics of projectiles, the prior art failed to effectively consider the impact of harsh weather such as heavy rain on the aerodynamic characteristics, resulting in increased computational complexity and loss of air efficiency.

Method used

Using the aerodynamic characteristics calculation method in heavy rain environments, the aerodynamic characteristics of the projectile under heavy rain conditions are simulated and calculated through three-dimensional modeling, structural mesh division and bidirectional momentum coupling. The aerodynamic characteristics of the projectile are simulated and calculated under heavy rain conditions, including continuous and discrete phases. Fluid simulation, simulates the interaction between raindrops and air, and obtains the aerodynamic characteristics data of the projectile.

Benefits of technology

It improves the accuracy and scope of simulation calculation, shortens the experimental cycle, reduces costs, and provides an effective method for rapid projectile design. It can obtain pneumatic data of the projectile under different working conditions, and is suitable for gas-liquid two-phase flow simulation.

✦ Generated by Eureka AI based on patent content.

Smart Images

  • Figure CN119026503A_ABST
    Figure CN119026503A_ABST
Patent Text Reader

Abstract

The invention discloses a projectile aerodynamic characteristic calculation method based on a rainstorm environment, and the method comprises the steps: carrying out the three-dimensional modeling of a projectile according to the full-size data of the projectile; establishing a fluid calculation domain of the external flow field of the projectile: firstly establishing a small cylinder calculation domain surrounding the projectile, and then establishing a large cylinder calculation domain surrounding the small cylinder; the overall fluid computational domain of the projectile is divided by adopting structural grids, and the grids of the boundary layer area of the projectile are divided by adopting outer O-Block; the divided grids are imported into numerical simulation software, continuous phase (air phase) fluid simulation is conducted firstly, then discrete phase (raindrop phase) fluid simulation is conducted, and trajectory tracking is conducted on a large number of raindrop particles in a flow field through a bidirectional momentum coupling Euler-Lagrange method; and data post-processing is carried out according to the simulation result, and projectile aerodynamic characteristic data are obtained. According to the method, the influence of the rainstorm environment on the aerodynamic characteristics of the projectile is considered, and the method has the advantages of high simulation calculation accuracy, low calculation cost, wide application range and the like.
Need to check novelty before this filing date? Find Prior Art

Description

Technical Field

[0001] The present invention belongs to the technical field of aerodynamic calculation of gas-liquid two-phase flow in multiphase flow, and in particular relates to a method for calculating aerodynamic characteristics of a projectile in a rainstorm environment. Background Art

[0002] In the process of projectile development, the aerodynamic characteristic parameters of the projectile are the basis for establishing the projectile dynamic equation. At present, computational fluid dynamics (CFD) is one of the main means to study aerodynamic problems such as projectiles, and has been paralleled with traditional wind tunnel experiments and shooting experiments. With the rapid development of CFD technology, combining numerical simulation with experimental models has become the mainstream method for studying the aerodynamic characteristics of projectiles. The process of numerical simulation usually includes three key stages: pre-processing, numerical calculation and post-processing. The pre-processing stage includes geometric modeling, meshing, etc. In the numerical calculation stage, fluid mechanics software (such as FLUENT, CFX, etc.) is used to solve, and the corresponding physical model, turbulence model, material properties and boundary conditions are set. The post-processing stage is to analyze and post-process the simulation results, such as the generation and display of the drag coefficient, lift coefficient, pitch moment coefficient, Mach number cloud map and pressure cloud map of the projectile.

[0003] In the existing technology, the aerodynamic characteristics of projectiles studied by CFD technology are mainly based on the study of air phase, which only considers the interaction between air and projectile. However, the actual environment is relatively complex, and severe weather such as heavy rain and strong cyclones will have a great impact on the aerodynamic characteristics of projectiles. Summary of the invention

[0004] Purpose of the invention: To address the problems of heavy rain causing the flow field of the projectile to become more complicated and the loss of air efficiency, a method for calculating the aerodynamic characteristics of a projectile in a heavy rain environment is provided.

[0005] Technical solution: To achieve the above purpose, the present invention provides a method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment, comprising the following steps:

[0006] S1: 3D modeling of the projectile based on the full-size data of the projectile;

[0007] S2: Establish the fluid calculation domain of the projectile's external flow field: first establish a small cylindrical calculation domain surrounding the projectile, and then establish a large cylindrical calculation domain surrounding the small cylinder;

[0008] S3: The overall fluid calculation domain of the projectile is divided into structural grids, and the grid of the projectile boundary layer area is divided into outer O-Blocks;

[0009] S4: Import the divided grid into the numerical simulation software, first perform the continuous phase (air phase) fluid simulation, then perform the discrete phase (raindrop phase) fluid simulation, and use the Euler-Lagrange method with bidirectional momentum coupling to track the trajectories of a large number of raindrop particles in the flow field;

[0010] S5: Perform data post-processing according to the simulation results in step S4 to obtain the aerodynamic characteristic data of the projectile.

[0011] Furthermore, in step S1, the projectile is simplified by retaining only two belts and ignoring the rounded corner at the stern of the projectile.

[0012] Furthermore, the step S2 is specifically as follows: first, a small cylindrical calculation domain is established around the projectile, with the center of the circle located at the center of gravity of the projectile, the far field in front of the calculation domain is 3D away from the center of gravity of the projectile, the far field in back is 4D away from the center of gravity of the projectile, the diameter of the small cylinder is 3D, and each part is named in the Part module of the model tree on the left side of the view window; then, a large cylindrical calculation domain is established to surround the small cylinder, the far field in front of the calculation domain is 26D away from the center of gravity of the projectile, the far field in back is 40D away from the center of gravity of the projectile, the diameter of the large cylinder is 30D, and each part is named in the Part module of the model tree on the left side of the view window.

[0013] Further, the step S3 is specifically as follows: firstly, structural meshing is performed on the small cylinder surrounding the projectile and the projectile, three layers of O-Block are created in the longitudinal direction of the small cylinder and the projectile, and then the projectile block is cut in the transverse direction; then, an O-type mesh cutting method suitable for mesh distortion at the vertex of the block with arc or other complex shapes of the geometric model is adopted, and the outer O-Block is cut for the projectile boundary layer area to generate a three-dimensional hexahedral structural mesh, and whether the mesh quality is qualified is judged, and the qualified structural mesh is converted into an unstructured mesh for storage;

[0014] Divide the large cylinder and the small cylinder surrounding the small cylinder into structural grids, create two layers of O-Blocks in the vertical direction, and then divide the blocks of the small cylinder in the horizontal direction to generate a three-dimensional hexahedral structural grid. Determine whether the grid quality is qualified, and convert the qualified structural grid into an unstructured grid for storage;

[0015] Merge the two saved sets of meshes.

[0016] Furthermore, the height of the first grid layer after the projectile boundary layer area is divided by the outer O-Block in step S3 is expressed as follows:

[0017]

[0018] Where Re is the incoming flow Reynolds number, ρ is the incoming flow density, u is the incoming flow velocity, l is the reference length of the projectile diameter, and μ is the incoming flow viscosity coefficient; C f is the wall friction coefficient, τ w is the wall shear stress, U t is the velocity calculated using the wall shear stress, y is the height of the first grid layer, y + represents the dimensionless distance between the first layer node and the wall. + When the selection is appropriate, the simulation of the boundary layer is more reasonable. + When the value changes, the simulation results show different differences under the same boundary conditions. + The actual value and the simulation value deviate greatly due to the value being too large or too small. + ≥30, preferably close to 30.

[0019] Furthermore, the step S4 specifically includes:

[0020] A1: Import the mesh merged in step S3 into the numerical simulation software, check the minimum orthogonal quality and minimum volume of the mesh, change the model size, and scale the model size to the actual value;

[0021] A2: Since raindrops need to be injected in the subsequent calculations and the interaction between the raindrop phase and the air phase needs to be considered, when calculating the air phase, a pressure-based steady-state solution model is selected, the SST k-ω turbulence model is selected, and the energy equation is turned on;

[0022] A3: Define material properties, set the fluid material to air, set the density to ideal gas, and use the Sutherland formula for the viscosity term;

[0023] A4: Set the operating pressure of the external flow field to 0Pa, so that the pressure in the external flow field is the absolute pressure;

[0024] A5: Define boundary conditions. The boundary conditions of the continuous phase air are set as pressure far-field boundary conditions. The standard atmospheric sea level pressure and temperature are taken as the inlet pressure and temperature. The wall boundary conditions of the projectile are set as a fixed wall without slip. The overlapped part of the two sets of grids is set as the interface.

[0025] A6: Create a grid interface. Select the interface created in step A5, name the interface interface, and click Create.

[0026] A7: Set the reference value, calculate the reference position as the pressure far field, and the reference surface as 1 / 4πD 2 =0.25×π×0.155 2≈0.1887m 2 , the reference length is the projectile diameter D = 0.155m;

[0027] A8: Set up the solver. In Solution Methods, select the Coupled algorithm, and select Second Order Upwind for momentum, turbulent kinetic energy, and turbulent dissipation rate.

[0028] A9: Set the residual monitor, and set all absolute residuals to less than 10 -5 ;

[0029] A10: Set the aerodynamic report of the projectile, including lift coefficient, drag coefficient and pitch moment coefficient;

[0030] A11: Set initialization, select standard initialization, calculate the reference position as far field, set the number of iterations, and start calculation;

[0031] A12: When the calculation in step A11 converges, define a discrete phase model, use the discrete particle model DPM to simulate raindrops, and use the Euler-Lagrange method with bidirectional momentum coupling to track the non-steady-state trajectories of discrete raindrop particles in the flow field, considering the interaction between the continuous phase and the raindrop phase.

[0032] Furthermore, in step A12, the discrete particle model DPM simulates raindrops by injecting raindrop particles into the continuous phase, and the three-dimensional Lagrangian motion equation of the raindrop particle motion is as follows:

[0033]

[0034] Among them, x p =(x p ,y p ,z p ) is the position of the raindrop particle, u p =(u p ,v p ,w p ) and u=(u,v,w) represent the raindrop and air velocity vectors respectively, g represents the gravitational acceleration, ρ a is the raindrop particle density, Re p is the raindrop particle Reynolds number, C D is the raindrop particle drag coefficient, D p is the raindrop size.

[0035] Furthermore, the rainfall environment when simulating raindrops in step A12 includes rainfall rate, terminal velocity and raindrop particle size, which are specifically set as follows:

[0036] The rainfall rate is evaluated. The relationship between rainfall amount and rainfall rate in a rainstorm environment is:

[0037] LWC=0.054×R 0.84 (3)

[0038] Where R is the rainfall rate in mm / h. Before the raindrop particles collide with the projectile surface, gravity will accelerate the raindrops, while air resistance will slow down the raindrops. When the speed of the raindrops increases to a certain extent, the uniform speed when the air resistance and gravity reach a balance is called the terminal velocity, which varies with the particle diameter and is estimated by the following formula:

[0039]

[0040] The diameter of the raindrop that plays the main role, that is, the particle size with the largest number of raindrops in a certain rainfall environment, is selected as the representative particle size, and D P To represent the raindrop size:

[0041]

[0042] Furthermore, in step A12, the method of using the Euler-Lagrange method with bidirectional momentum coupling to track the trajectory of discrete raindrop particles in the flow field is as follows:

[0043] The calculation of the random diffusion of raindrops due to turbulence in the continuous phase is described using the integral time scale T, which describes the time spent on turbulent motion along the raindrop path ds and is defined as:

[0044]

[0045] Among them, u′ p (t) is the pulsation speed of the raindrop, is the turbulent diffusion rate of raindrops. The instantaneous air velocity is used in equation (2) to calculate the turbulent diffusion of particles. During the integration of the particle trajectory equation, the fluid (air) velocity is expressed as represents the average air velocity, and u′(t) is the instantaneous value of air velocity fluctuation. This method is used to track raindrop particles.

[0046] Furthermore, in step A12, the boundary conditions of the discrete phase are set, and a non-steady-state solution is adopted for the discrete phase particles, specifically: a raindrop particle incident surface is created at 5 times the projectile diameter in front of the projectile; in order to calculate the total mass flow rate of raindrops in the flow field, the area of ​​the incident surface is multiplied by the fluid velocity to obtain the volume flow rate, and the volume flow rate is multiplied by the rainfall intensity (LWC) to obtain the total mass flow rate; the projectile surface is set to the wall-film boundary condition, the entire external flow field surface is set to escape, and the collision between raindrops and the projectile surface adopts the Stanton-Rutland model;

[0047] When simulating the rainfall environment, it is assumed that the projectile is stationary and the projectile velocity is converted into the incoming flow velocity. After the raindrop is injected from the incident surface, in addition to its own falling speed, the raindrop will also be affected by the incoming flow wind speed in the calculation domain;

[0048] In the DPM wall liquid film model, when the stress of forming the liquid film exceeds the adhesion of the liquid film to the wall, the liquid film will separate from the wall; when a single droplet hits the wall, the interaction state between the walls will undergo four phenomena: adhesion, spreading, rebound and splashing;

[0049] When the temperature is lower than the boiling point of the liquid, the impact particles can adhere, spread, or splash, while when the temperature is higher than the boiling point of the liquid, the particles can rebound or splash. The impact energy of the droplet hitting the projectile wall is:

[0050]

[0051] Where E is the dimensionless impact energy, ρ is the liquid density, D is the diameter of the impacting particle, and V r is the relative velocity between the droplet and the wall (m / s), h 0 is the initial film thickness (m), σ is the surface tension of the droplet (N / m), δ b1 is the boundary layer thickness.

[0052] Beneficial effects: Compared with the prior art, the present invention has the following advantages:

[0053] 1. The simulation calculation has high accuracy. Compared with the numerical calculation results of aerodynamic characteristics of wind tunnel experiments and flight experiments, the experimental cycle is greatly shortened, while the cost is reduced, providing an effective and feasible method for rapid design of projectiles. By combining the aerodynamic data calculated in this application with the experimental data measured by wind tunnel experiments, the aerodynamic data of the newly developed projectile can be effectively and quickly obtained, thereby providing effective support for accelerating the development progress of projectile models and saving development costs.

[0054] 2. Wide application scope. The three-dimensional numerical simulation used in the present invention has a flow field physical model that can describe the real flow field characteristics. It is not only suitable for the simulation of the aerodynamic characteristics of the projectile under the air flow field, but also for the simulation of the gas-liquid two-phase flow under rainy conditions. Moreover, it can obtain the data such as the drag coefficient, lift coefficient, pitch moment coefficient, Mach number cloud map, pressure cloud map, streamline and trajectory of the projectile under different working conditions, that is, different Mach numbers and different angles of attack.

[0055] 3. The nested grid division method provided by the present invention merges two sets of grids. In view of the circular structure of the cross-section of the projectile, the longitudinal O-Block division method is adopted, the outer O-Block division is adopted for the projectile boundary layer, and the grid near the projectile is encrypted, which reduces the number of grids, improves the calculation accuracy, and saves the calculation cost. BRIEF DESCRIPTION OF THE DRAWINGS

[0056] Figure 1 It is a three-dimensional model diagram of the projectile and the external flow field of the present invention;

[0057] Figure 2 is a flow chart of the grid division process of the present invention;

[0058] Figure 3 This is a schematic diagram of the three-dimensional structure grid after the grids of the present invention are merged

[0059] Figure 4 is a schematic diagram of a longitudinal cross-section grid after the grids of the present invention are merged;

[0060] Figure 5 is a schematic diagram of the grids around the projectile after the grids of the present invention are merged;

[0061] Figure 6 is the y calculated by the present invention + Value diagram;

[0062] Figure 7 Schematic diagram of the wall liquid film model in the present invention;

[0063] Figure 8 It is a schematic diagram of the wall effect in the present invention;

[0064] Figure 9-13 They are respectively the drag coefficient, lift coefficient, pitch moment coefficient, Mach number cloud diagram and pressure cloud diagram of the present invention in a rainless environment;

[0065] Figure 14-18 They are respectively the drag coefficient, lift coefficient, pitch moment coefficient, Mach number cloud diagram and pressure cloud diagram of the present invention in a rainy environment;

[0066] Fig.19 is a schematic diagram of raindrops around a projectile in the present invention;

[0067] Fig. 20 It is a height diagram of the liquid film formed on the surface of the projectile according to the present invention. DETAILED DESCRIPTION

[0068] The present invention is further explained below in conjunction with the accompanying drawings and specific embodiments. It should be understood that these embodiments are only used to illustrate the present invention and are not used to limit the scope of the present invention. After reading the present invention, various equivalent forms of modifications to the present invention by those skilled in the art all fall within the scope defined by the claims attached to this application.

[0069] This embodiment provides a method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment, which is suitable for numerical simulation of the external flow field of a projectile in a rainstorm environment using the software ANSYS Fluent, and specifically includes the following steps:

[0070] Step 1: Use the 3D modeling software SolidWorks to perform 3D modeling based on the full-size data of a real projectile. The total length of the projectile is 909 mm, the diameter of the projectile is 155 mm, the center of gravity of the projectile is 606 mm from the top of the projectile, and the coordinate origin is located at the center of gravity;

[0071] In order to facilitate grid division, the projectile model is appropriately simplified, that is, only two belts are retained and the fillet at the stern of the projectile is ignored.

[0072] Step 2: Use the ICEM 3D modeling module to establish the fluid calculation domain of the projectile's external flow field: first establish a small cylindrical calculation domain surrounding the projectile, the front far field of the calculation domain is 3D away from the center of gravity of the projectile (D is the diameter of the projectile), the rear far field is 4D away from the center of gravity of the projectile, and the diameter of the small cylinder is 3D;

[0073] Then establish a large cylindrical calculation domain surrounding the small cylinder. The front far field of the calculation domain is 26D away from the center of gravity of the projectile, the rear far field is 40D away from the center of gravity of the projectile, and the diameter of the large cylinder is 30D.

[0074] Step 3: The overall fluid calculation domain of the projectile is divided into structural grids, and the grid of the boundary layer around the projectile is divided into outer O-Blocks. After division, the total number of hexahedral structural grids generated is about 3.72×10 6 , the grid size near the projectile reaches 5×10 -5 m.

[0075] Step 4: Import the divided grid into the FLUENT numerical simulation software, set the corresponding physical model, turbulence model, material properties and boundary conditions, first perform continuous phase (air phase) fluid simulation, and after the calculation converges, perform discrete phase (raindrop phase) fluid simulation, and use the Euler-Lagrange method with bidirectional momentum coupling to track the trajectories of a large number of raindrop particles in the flow field.

[0076] Step 5: Perform post-processing and obtain the aerodynamic characteristic data such as the drag coefficient, lift coefficient, pitch moment coefficient, Mach number cloud map and pressure cloud map of the projectile based on the FLUENT calculation results.

[0077] The size of the fluid calculation domain established in step 2 of this embodiment is related to the calculation problem. The large cylinder established must be large enough to reduce the influence of the wall area on the external flow field of the projectile. At the same time, it is necessary to take into account the size of the overall external flow field calculation amount and ensure the accuracy of the calculation. Therefore, in order to reduce the number of overall grids and ensure that the grids around the projectile are fine enough, in this embodiment, a small cylindrical calculation domain surrounding the projectile is first established around the projectile. The center of the circle is located at the center of gravity of the projectile. The front far field of the calculation domain is 3D away from the center of gravity of the projectile, and the rear far field is 4D away from the center of gravity of the projectile. The diameter of the small cylinder is 3D. The Part module of the model tree on the left side of the view window is used to name each part; then a large cylindrical calculation domain surrounding the small cylinder is established. The front far field of the calculation domain is 26D away from the center of gravity of the projectile, and the rear far field is 40D away from the center of gravity of the projectile. The diameter of the large cylinder is 30D. The Part module of the model tree on the left side of the view window is used to name each part. The established projectile model and external flow field calculation model are as follows: Figure 1 shown.

[0078] Reference Figure 2 In step 3 of this embodiment, when dividing the grid, first divide the small cylinder surrounding the projectile and the projectile into structural grids, create three layers of O-Blocks for the small cylinder and the projectile in the longitudinal direction, and then divide the projectile blocks (Block) in the transverse direction. The purpose is to divide the projectile blocks. Mapping association, mapping association refers to the process of matching the nodes, edges and faces in the grid model with the corresponding entities in the geometric model. This process ensures that the grid model can accurately reflect the actual physical form; the main function of mapping association is to ensure the consistency of the grid model and the geometric model. Since the cross-section of the calculation domain of the projectile and the cylinder is circular, the O-type grid cutting method suitable for the grid distortion at the vertex of the block with arcs or other complex shapes in the geometric model is adopted. The outer O-Block cutting is used for the boundary layer area of ​​the projectile. The purpose is to encrypt the grid around the projectile, where the height of the first layer of grid is set to 5×10 -5 m, generate a three-dimensional hexahedral structured grid, determine whether the grid quality is qualified, and convert the qualified structured grid into an unstructured grid for storage. Then divide the large cylinder and the small cylinder surrounding the small cylinder into a structured grid, create two layers of O-Blocks for it vertically, and then divide the blocks of the small cylinder horizontally to generate a three-dimensional hexahedral structured grid, determine whether the grid quality is qualified, and convert the qualified structured grid into an unstructured grid for storage. Finally, merge the two sets of grids, and the structured grid obtained by the division is as follows: Figure 3-5 shown.

[0079] The above first layer grid height is expressed as follows:

[0080]

[0081] Where Re is the incoming flow Reynolds number, ρ is the incoming flow density, u is the incoming flow velocity, l is the reference length of the projectile diameter, and μ is the incoming flow viscosity coefficient; C f is the wall friction coefficient, τ w is the wall shear stress, U t is the velocity calculated using the wall shear stress, and y is the height of the first grid layer. + Represents the dimensionless distance between the first layer node and the wall, which is used to capture the flow conditions near the wall. + When the selection is appropriate, the simulation of the boundary layer is more reasonable. + When the value changes, the simulation results show different differences under the same boundary conditions. + Too large or too small a value will cause a large deviation between the real value and the simulated value, such as Figure 6 As shown, the y used in this embodiment + Around 30.

[0082] Step 4 of this embodiment specifically includes the following steps:

[0083] Step 4.1: Import the merged mesh in step 3 into Fluent software, check the minimum orthogonal quality and minimum volume of the mesh, change the model size, and scale the model size to the actual value;

[0084] Step 4.2: Since raindrops need to be injected in the subsequent calculations and the interaction between the raindrop phase and the air phase is considered, when calculating the air phase, select the pressure-based steady-state solution model, select the SSTk-ω turbulence model and turn on the energy equation;

[0085] Step 4.3: Define material properties. The fluid material is air, the density is set to ideal gas, and the viscosity term is Sutherland's formula.

[0086] Step 4.4: Set the operating pressure of the external flow field to 0Pa, so that the pressure in the external flow field is the absolute pressure;

[0087] Step 4.5: Define boundary conditions. The boundary conditions of the continuous phase air are set as pressure far-field boundary conditions. The standard atmospheric sea level pressure and temperature are taken as the inlet pressure and temperature. The Mach number Ma is 2, the angle of attack is 5°, and the wall boundary condition of the projectile is set as a fixed wall with no slip. The overlapped part of the two sets of grids is set as the interface.

[0088] Step 4.6: Create a meshing interface. Select the interface created in step 4.5, name the interface interface, and click Create.

[0089] Step 4.7: Set the reference value, calculate the reference position as the pressure far field, and the reference surface as 1 / 4πD 2 =0.25×π×0.155 2 ≈0.1887m 2 , the reference length is the projectile diameter D = 0.155m;

[0090] Step 4.8: Set up the solver. In Solution Methods, select the Coupled algorithm, and select Second Order Upwind for momentum, turbulent kinetic energy, and turbulent dissipation rate.

[0091] Step 4.9: Set the residual monitor, and set all absolute residuals to less than 10 -5 ;

[0092] Step 4.10: Set up the aerodynamic report of the projectile, including lift coefficient, drag coefficient and pitching moment coefficient;

[0093] Step 4.11: Set initialization, select standard initialization, calculate the reference position as far field, set the number of iterations, and start calculation;

[0094] Step 4.12: After the calculation of step 4.11 converges, define a discrete phase model, use a discrete particle model DPM to simulate raindrops, and use the Euler-Lagrange method with bidirectional momentum coupling to track the non-steady-state trajectory of discrete raindrop particles in the flow field, considering the interaction between the continuous phase and the raindrop phase. This model injects raindrop particles into the continuous phase. In the present invention, it is assumed that the raindrops have no evaporation, no interaction between raindrops, and are non-deformed spherical raindrops, which are only affected by resistance and gravity. The three-dimensional Lagrangian motion equation of the raindrop particle movement is as follows:

[0095]

[0096] Among them, x p =(x p ,y p ,z p ) is the position of the raindrop particle, u p =(u p ,v p ,w p ) and u=(u,v,w) represent the raindrop and air velocity vectors respectively, g represents the gravitational acceleration, ρ a is the raindrop particle density, Rep is the raindrop particle Reynolds number, C D is the raindrop particle drag coefficient, D p is the raindrop size;

[0097] The rainfall environment for rainfall simulation needs to take into account three aspects: rainfall rate, terminal velocity and raindrop size, as follows:

[0098] Rainfall simulation requires an assessment of the rainfall rate. A rainfall rate greater than 100 mm / h is usually considered heavy rain. The relationship between rainfall and rainfall rate in a rainstorm environment is:

[0099] LWC=0.054×R 0.84 (3)

[0100] Where R is the rainfall rate in mm / h. Before the raindrop particles collide with the projectile surface, gravity will accelerate the raindrops, while air resistance will slow down the raindrops. When the speed of the raindrops increases to a certain extent, the uniform speed when the air resistance and gravity reach a balance is called the terminal velocity, which varies with the particle diameter and can be estimated by the following formula:

[0101]

[0102] The unit of raindrop velocity is m / s. In this embodiment, in order to simplify the calculation, the raindrop diameter that plays a major role, that is, the particle size with the largest number of raindrops in a certain rainfall environment, is selected as the representative particle size, and D is used. P To represent the raindrop size:

[0103]

[0104] Among them, the empirical coefficients of a and b are 1.2 and 0.232 respectively, and l is the rain type constant of 2.25.

[0105] The rainfall parameters used in this embodiment are shown in the following table:

[0106]

[0107] The calculation of random diffusion of raindrops due to turbulence in the continuous phase is described using the integral time scale T, which describes the time spent in turbulent motion along the raindrop path ds and is defined as:

[0108]

[0109] Among them, u′ p (t) is the pulsation speed of the raindrop, is the turbulent diffusion rate of raindrops. The instantaneous air velocity is used in equation (2) to calculate the turbulent diffusion of particles. During the integration of the particle trajectory equation, the fluid (air) velocity is expressed as represents the average air velocity, and u′(t) is the instantaneous value of air velocity fluctuation. This method is used to track raindrop particles.

[0110] The boundary conditions of the discrete phase are solved in an unsteady state for the discrete phase particles, and a particle incident surface is defined. In order to ensure that the raindrop particles can fully fall on the surface of the projectile, a raindrop particle incident surface is created in this embodiment at 5 times the projectile diameter in front of the projectile; in order to calculate the total mass flow rate of raindrops in the flow field, the area of ​​the incident surface is multiplied by the fluid velocity to obtain the volume flow rate, and the volume flow rate is multiplied by the rainfall intensity (LWC) to obtain the total mass flow rate. The projectile surface is set as the wall-film boundary condition, the entire external flow field surface is set as escape, and the collision between raindrops and the projectile surface adopts the Stanton-Rutland model.

[0111] When simulating a rainfall environment, it is assumed that the projectile is stationary and the projectile velocity is converted into the incoming flow velocity. After the raindrops are injected from the incident surface, in addition to their own falling speed, the raindrops will also be affected by the incoming flow wind speed in the computational domain.

[0112] In the DPM wall liquid film model, the formation of the wall liquid film is mainly due to the collision between the droplet and the projectile wall. The physical phenomena that occur mainly consist of the following parts: the collision interaction between the droplet and the wall, the particle tracking after the droplet contacts the wall, the height calculation after the liquid film is formed on the wall, and the coupling calculation between the gas and liquid phases. When the droplet contacts the projectile wall, the main physical processes that affect the liquid film include: mass and momentum heat and mass transfer, flow separation and shear fragmentation caused by droplet impact, droplet splash effect, evaporation, shear force on the film, dynamic pressure effect, gravity drive, etc. Figure 7 shown.

[0113] When the stress of forming the liquid film exceeds the adhesion of the liquid film to the wall, the liquid film will separate from the wall. When a single droplet hits the wall, the interaction between the walls will undergo four phenomena: adhesion, spreading, rebound and splashing. The simplified wall contact effect is as follows: Figure 8 shown.

[0114] When the temperature is lower than the boiling point of the liquid, the impact particles can adhere, spread, or splash, while when the temperature is higher than the boiling point of the liquid, the particles can rebound or splash. The impact energy of the droplet hitting the projectile wall is:

[0115]

[0116] Where E is the dimensionless impact energy, ρ is the liquid density, D is the diameter of the impacting particle, and V r is the relative velocity between the droplet and the wall (m / s), h 0 is the initial film thickness (m), σ is the surface tension of the droplet (N / m), δ b1 is the boundary layer thickness. In the present invention, since the temperature is lower than the boiling point, the particles will adhere, spread and splash, resulting in a decrease in aerodynamic efficiency.

[0117] Step 5 of this embodiment performs post-processing on the projectile to obtain the aerodynamic report and simulation diagram of the projectile. In a rainless environment, set initialization, select standard initialization for iterative calculation, and calculate until convergence reaches about 500 steps. The drag coefficient, lift coefficient, pitch moment coefficient, pressure cloud diagram and Mach number cloud diagram of the projectile in a rainless environment are obtained as follows: Figure 9-13 As shown, the drag coefficient, lift coefficient and pitch moment coefficient are 0.3304, 0.2624 and 0.4175 respectively;

[0118] After the iteration converges in the rainless environment, set the DPM model, DPM iteration time interval, and perform a DPM iteration every 30 continuous phase iterations. The time step is 0.0001s until the two phases converge. The unsteady-state method is used to track the motion trajectory of raindrop particles. The maximum number of tracking steps for particles is set to 500,000, and the time interval between two trackings is set to 0.00001. In the heavy rain environment, the aerodynamic report and simulation diagram of the projectile are obtained, and the drag coefficient, lift coefficient, pitch moment coefficient, pressure cloud map and Mach number cloud map of the projectile in the heavy rain environment are obtained as follows: Figure 14-18 As shown, the drag coefficient, lift coefficient and pitching moment coefficient are 0.3036, 0.2291 and 0.3656 respectively. It can be seen that in a rainstorm environment, when the Mach number is 2Ma and the angle of attack is 5°, the drag coefficient of the supersonic projectile is reduced by 8.83%. This is due to the presence of water film on the surface of the projectile, which reduces the surface roughness of the projectile and thus plays a lubricating role on the projectile; the lift coefficient of the projectile is reduced by 14.53%, the pitching moment coefficient of the projectile is reduced by 14.2%, and the lift-to-drag ratio is reduced by 5.25%. In addition, the influence of rainstorm on the lift coefficient of the projectile is greater than that on the drag coefficient. Fig.19 is the raindrop trajectory diagram of the projectile, Fig. 20 is the height of the liquid film formed on the projectile wall, and the maximum liquid film height is close to 0.0591mm.

Claims

1. A method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment, characterized in that: The steps include: S1: 3D modeling of the projectile based on the full-size data of the projectile; S2: Establish the fluid calculation domain of the projectile's external flow field: first establish a small cylindrical calculation domain surrounding the projectile, and then establish a large cylindrical calculation domain surrounding the small cylinder; S3: The overall fluid calculation domain of the projectile is divided into structural grids, and the grid of the projectile boundary layer area is divided into outer O-Blocks; S4: Import the divided grid into the numerical simulation software, first perform continuous phase fluid simulation, then perform discrete phase fluid simulation, and use the Euler-Lagrange method with bidirectional momentum coupling to track the trajectories of a large number of raindrop particles in the flow field; S5: Perform data post-processing according to the simulation results in step S4 to obtain the aerodynamic characteristic data of the projectile.

2. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 1 is characterized in that: In step S1, the projectile is simplified, only two belts are retained and the rounded corner at the stern of the projectile is ignored.

3. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 1 is characterized in that: The step S2 is specifically as follows: first, a small cylindrical calculation domain is established around the projectile, the center of the circle is located at the center of gravity of the projectile, the front far field of the calculation domain is 3D away from the center of gravity of the projectile, the rear far field is 4D away from the center of gravity of the projectile, the diameter of the small cylinder is 3D, and each part is named in the Part module of the model tree on the left side of the view window; then, a large cylindrical calculation domain is established to surround the small cylinder, the front far field of the calculation domain is 26D away from the center of gravity of the projectile, the rear far field is 40D away from the center of gravity of the projectile, the diameter of the large cylinder is 30D, and each part is named in the Part module of the model tree on the left side of the view window.

4. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 3 is characterized in that: The step S3 specifically comprises: firstly dividing the small cylinder surrounding the projectile and the projectile into structural grids, creating three layers of O-Blocks in the longitudinal direction of the small cylinder and the projectile, and then dividing the projectile block in the transverse direction; then using the O-type grid dicing method suitable for the grid distortion at the vertex of the block with arc or other complex shapes of the geometric model, using the outer O-Block dicing for the projectile boundary layer area, generating a three-dimensional hexahedral structural grid, judging whether the grid quality is qualified, and converting the qualified structural grid into an unstructured grid for storage; Divide the large cylinder and the small cylinder surrounding the small cylinder into structural grids, create two layers of O-Blocks in the vertical direction, and then divide the blocks of the small cylinder in the horizontal direction to generate a three-dimensional hexahedral structural grid. Determine whether the grid quality is qualified, and convert the qualified structural grid into an unstructured grid for storage; Merge the two saved sets of meshes.

5. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 4 is characterized in that: The height of the first grid layer after the projectile boundary layer area is divided by the outer O-Block in step S3 is expressed as follows: Where Re is the incoming flow Reynolds number, ρ is the incoming flow density, u is the incoming flow velocity, l is the reference length of the projectile diameter, and μ is the incoming flow viscosity coefficient; C f is the wall friction coefficient, τ w is the wall shear stress, U t is the velocity calculated using the wall shear stress, y is the height of the first layer of grid, y + Represents the dimensionless distance between the first layer node and the wall.

6. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 4 is characterized in that: The step S4 specifically includes: A1: Import the merged grid in step S3 into the numerical simulation software; A2: When calculating the air phase, select the steady-state solution model based on pressure, select the SSTk-ω turbulence model and turn on the energy equation; A3: Define material properties; A4: Set the operating pressure of the external flow field to 0Pa, so that the pressure in the external flow field is the absolute pressure; A5: Define boundary conditions. The boundary conditions of the continuous phase air are set as pressure far-field boundary conditions. The standard atmospheric sea level pressure and temperature are taken as the inlet pressure and temperature. The wall boundary conditions of the projectile are set as a fixed wall without slip. The overlapped part of the two sets of grids is set as the interface. A6: Create a grid interface. Select the interface created in step A5, name the interface interface, and click Create. A7: Set the reference value and calculate the reference position as the pressure far field; A8: Set the solver. In SolutionMethods, select the Coupled algorithm, and select SecondOrder Upwind for momentum, turbulent kinetic energy, and turbulent dissipation rate. A9: Set up residual monitor; A10: Set the aerodynamic report of the projectile, including lift coefficient, drag coefficient and pitch moment coefficient; A11: Set initialization, select standard initialization, calculate the reference position as far field, set the number of iterations, and start calculation; A12: When the calculation in step A11 converges, define a discrete phase model, use the discrete particle model DPM to simulate raindrops, and use the Euler-Lagrange method with bidirectional momentum coupling to track the non-steady-state trajectories of discrete raindrop particles in the flow field, considering the interaction between the continuous phase and the raindrop phase.

7. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 6 is characterized in that: In step A12, the discrete particle model DPM simulates raindrops by injecting raindrop particles into the continuous phase. The three-dimensional Lagrangian motion equation of the raindrop particle motion is as follows: Among them, x p =(x p ,y p ,z p ) is the position of the raindrop particle, u p =(u p ,v p ,w p ) and u=(u,v,w) represent the raindrop and air velocity vectors respectively, g represents the gravitational acceleration, ρ a is the raindrop particle density, Re p is the raindrop particle Reynolds number, C D is the raindrop particle drag coefficient, D p is the raindrop size.

8. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 7 is characterized in that: The rainfall environment when simulating raindrops in step A12 includes rainfall rate, terminal velocity and raindrop particle size, which are specifically as follows: The rainfall rate is evaluated. The relationship between rainfall amount and rainfall rate in a rainstorm environment is: LUCK=0.054×R 0.84 (3) Where R is the rainfall rate; the uniform velocity when air resistance and gravity are balanced is called the terminal velocity, which varies with the particle diameter and is estimated by the following formula: The diameter of the raindrops that play a major role, that is, the diameter of the raindrops with the largest number in the rainfall environment, is selected as the representative particle size, and D P To represent the raindrop size: 。 9. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 7, characterized in that: The method of using the Euler-Lagrange method of bidirectional momentum coupling to track the trajectory of discrete raindrop particles in the flow field in step A12 is: The calculation of the random diffusion of raindrops due to turbulence in the continuous phase is described using the integral time scale T, which describes the time spent on turbulent motion along the raindrop path ds and is defined as: Among them, u′ p (t) is the pulsation speed of the raindrop, is the turbulent diffusion rate of raindrops. The instantaneous air velocity is used in equation (2) to calculate the turbulent diffusion of particles. During the integration of the particle trajectory equation, the fluid velocity is expressed as represents the average air velocity, and u′(t) is the instantaneous value of air velocity pulsation.

10. The method for calculating the aerodynamic characteristics of a projectile in a rainstorm environment according to claim 9, characterized in that: In the step A12, the boundary conditions of the discrete phase are set, and a non-steady-state solution is adopted for the discrete phase particles, specifically: a raindrop particle incident surface is created at 5 times the projectile diameter in front of the projectile; in order to calculate the total mass flow rate of raindrops in the flow field, the volume flow rate is obtained by multiplying the area of ​​the incident surface by the fluid velocity, and the total mass flow rate is obtained by multiplying the volume flow rate by the rainfall intensity; the projectile surface is set as the wall liquid film boundary condition, the entire external flow field surface is set as escape, and the collision between raindrops and the projectile surface adopts the Stanton-Rutland model; When simulating the rainfall environment, it is assumed that the projectile is stationary and the projectile velocity is converted into the incoming flow velocity. After the raindrop is injected from the incident surface, in addition to its own falling speed, the raindrop will also be affected by the incoming flow wind speed in the calculation domain; In the DPM wall liquid film model, when the stress of forming the liquid film exceeds the adhesion of the liquid film to the wall, the liquid film will separate from the wall; when a single droplet hits the wall, the interaction state between the walls will undergo four phenomena: adhesion, spreading, rebound and splashing; When the temperature is lower than the boiling point of the liquid, the impact particles can adhere, spread, or splash, while when the temperature is higher than the boiling point of the liquid, the particles can rebound or splash. The impact energy of the droplet hitting the projectile wall is: Where E is the dimensionless impact energy, ρ is the liquid density, D is the diameter of the impacting particle, and V r is the relative velocity between the droplet and the wall, h0 is the initial film thickness (m), σ is the surface tension of the droplet, and δ b1 is the boundary layer thickness.

Citation Information

Cited By

  • Self-adaptive simulation method for sailing flow field of channel boat

    CN119598614A

  • Dynamic and pneumatic elasticity calculation method based on structure reduced-order model

    CN119783270A