A method for machining crane threads using a CNC lathe
By using layered cutting and adjusting the limit coordinates of the thread, the vibration and accuracy problems in thread machining on CNC lathes were solved, achieving efficient and precise thread machining.
Patent Information
- Application Number
- CN202311401468.7
- Authority / Receiving Office
- CN · China
- Patent Type
- Patents(China)
- Current Assignee / Owner
- Filing Date
- 2023-10-26
- Publication Date
- 2026-11-10
- Estimated Expiration
- 2043-10-26
AI Technical Summary
When machining threads on a CNC lathe, the cutting tool is prone to vibration, which causes vibration marks on the thread surface. Existing technology makes it difficult to effectively control the relative position of the thread on the part, resulting in low machining efficiency and easy errors.
By adopting a layered cutting method, the cutting depth and the tool are moved along the Z-axis, and the limit coordinates of the left and right offset tools are updated to achieve multi-layered thread cutting, thereby reducing the cutting difficulty and vibration.
It improves the cutting efficiency of thread machining, reduces the generation of vibration marks, ensures machining accuracy and reliability, and adapts to the machining needs of different thread specifications.
Smart Images

Figure CN117464100B_ABST
Abstract
Description
Technical Field
[0001] This invention relates to thread processing methods, specifically to a method for processing crane threads using a CNC lathe. Background Technology
[0002] Offshore cranes require bolted connections for installation, which involves machining the bolts. Machining threads on a CNC lathe essentially involves creating specially shaped helical grooves by synchronously rotating the cutting tool and spindle. During thread machining, the CNC lathe uses an oblique infeed method. As the depth of cut increases, the cutting load on the cutting tool becomes larger. With this increased load, the cutting tool is prone to vibration during the cutting process, resulting in chatter marks on the thread surface.
[0003] Chinese patent application No. 201010548760.8, published on May 23, 2012, discloses a method for machining large-pitch triangular tapered threads. The method involves using a cutting tool tip to cut along the thread profile angle point by point, layer by layer. During machining, the tool can be fed from both the left and right sides. After cutting from the left and right sides, the thread to be machined can be formed in the middle. When there is a lot of residual material on the thread from the left and right feeds, a straight feed method can be used to cut off the residual material on the thread. During machining, the corresponding initial machining depth can be set as needed, and then the machine tool system calculates and gradually increases the cutting depth according to the program requirements.
[0004] This machining method uses the tool tip to machine point by point along the thread profile angle, layer by layer. The tool tip uses a left-right infeed method. However, to achieve left-right infeed on a CNC lathe, it is necessary to change the relative position of the thread on the workpiece. Currently, there are two ways to change the relative position of the thread on the workpiece. The first method is to delay the start time of the thread turning action, but this requires delaying the start time of the thread turning action at an angle, making it difficult to control the offset. The second method is to change the starting position of the thread action, which can be achieved through the G76 or G92 commands. However, the G76 command uses an oblique infeed method, which can cause vibration marks on the thread. When cutting with the G92 command, the corresponding tool entry coordinates need to be written for each cut, which is inefficient and prone to errors. Summary of the Invention
[0005] This invention provides a method for machining crane threads using a CNC lathe. The CNC lathe performs layered cutting of multiple threads, which reduces the cutting difficulty. Each layer of cutting involves first adjusting the cutting depth and then moving along the Z-axis. Since the groove depth remains constant when cutting along the Z-axis of the thread, the tool only needs to perform longitudinal feed to the left or right. The cutting method is simple, efficient, and less prone to errors.
[0006] To achieve the above objectives, the technical solution of the present invention is: a method for machining crane threads using a CNC lathe, comprising the following steps: S1, preset the standard thread diameter D of the workpiece to be processed, the first thread cutting diameter d1, the thread finishing diameter d2, the thread pitch F, the Z-axis starting coordinate Z0, the Z-axis ending coordinate Z1, the X-axis starting coordinate X0, the X-axis ending coordinate X1, the depth of cut t, the offset amount T, the thread angle A, the retraction diameter d3, and the thread root width W.
[0007] S2. Determine the thread taper by subtracting the thread's X-axis end point coordinate X1 from the thread's X-axis starting point coordinate X0.
[0008] S3, Through Calculate the right limit coordinate T1 of the left and right deflection tools.
[0009] S4. Calculate the left limit coordinate T2 of the left and right deflectors using T2 = -T1.
[0010] S5. The tool moves to the preset feed coordinate.
[0011] S6. The tool moves from the feed coordinate to the Z-axis endpoint coordinate Z1 of the thread as one pass. The first pass moves from the left limit coordinate T2 of the left and right offset coordinates to the right limit coordinate T1.
[0012] S7. Determine whether the current thread machining diameter d4 is equal to the thread finishing diameter d2. If the current thread machining diameter d4 is greater than the thread finishing diameter d2, proceed to S8; if the current thread machining diameter d4 is equal to the thread finishing diameter d2, proceed to S11.
[0013] S8. Increase the tool deviation amount T by the current left limit coordinate, and update the left limit coordinate T2a of the next tool movement; determine the right limit coordinate T1a of the next tool movement by the updated left limit coordinate T2a.
[0014] S9. Proceed to the next feed. Along the X-axis of the thread, the tool moves a distance t towards the X-axis endpoint coordinate X1 of the thread to adjust the tool's starting point on the X-axis. Along the Z-axis of the thread, the tool moves a distance T to adjust the tool's starting point on the Z-axis, moving from the updated left limit coordinate T2a to the updated right limit coordinate T1a.
[0015] S10. Determine if the tool has moved to the updated right limit coordinate T1a. If not, repeat S9 to continue moving the tool along the Z-axis direction of the thread. If yes, proceed to S12.
[0016] S11. Repeat S7-S10 to continue machining the thread until the current thread machining diameter d4 is equal to the thread finishing diameter d2; then proceed to S12.
[0017] S12. The tool moves along the retraction diameter d3 and separates from the workpiece, ending the thread machining.
[0018] The above method cuts the width of the thread along the Z-axis and the depth of the thread along the X-axis. During cutting, the tool first moves along the Z-axis of the thread, performing the first layer of cutting based on the left and right limit coordinates of the cutting tool. Then, the left and right limit coordinates are updated, and the tool moves along the X-axis of the thread, changing the cutting depth on the workpiece. Then, the tool moves from the updated left limit coordinates to the updated right limit coordinates to perform the second layer of cutting. Through the multi-layer movement of the tool, layered cutting of the thread is achieved, reducing the cutting difficulty. Each layer of cutting adopts a straight feed followed by left and right turning. Since the groove depth remains unchanged during left and right cutting, the tool only needs to perform longitudinal feed to the left or right. The cutting method is simple, efficient, and less prone to errors. By cutting layer by layer along the depth of the thread, vibration of each layer of cutting is reduced, thus reducing the generation of chatter marks.
[0019] After each layer of cutting is completed, the left and right limit coordinates are updated. The updated data is used to determine the cutting start and end points of the next layer, thereby controlling the shape of the cut.
[0020] Simultaneously, it can calculate the left and right limit coordinates of the offset tool corresponding to different cutting layers based on preset parameters. The tool moves according to the preset offset amount and depth of cut, which has good reliability. When it is necessary to process threads of different specifications, it is only necessary to change the data of the preset parameters to process threads of different specifications.
[0021] Furthermore, the diameter d1 of the first thread cutting operation is greater than the diameter d2 of the thread finishing operation.
[0022] The above method avoids interference between the first thread cutting diameter d1 and the thread finishing diameter d2, thus allowing the tool to achieve the required dimension of the thread finishing diameter d2 through layered cutting, resulting in high precision.
[0023] Furthermore, the thread angle A is less than the angle of the cutting tool.
[0024] The above methods avoid tool marks on the machined thread when the thread angle A is the same as the tool angle, which affects the surface roughness; by reducing the thread angle A, the surface roughness of the thread is improved. Attached Figure Description
[0025] Figure 1 This is a flowchart of the present invention.
[0026] Figure 2 This is a schematic diagram of the thread processing according to the present invention. Detailed Implementation
[0027] The present invention will now be described in further detail with reference to the accompanying drawings and specific embodiments.
[0028] like Figure 1-2 As shown, a method for machining crane threads using a CNC lathe includes the following steps: S1. Preset the standard thread diameter D of the workpiece to be machined, the first thread cutting diameter d1, the thread finishing diameter d2, the thread pitch F, the Z-axis starting coordinate Z0, the Z-axis ending coordinate Z1, the X-axis starting coordinate X0, the X-axis ending coordinate X1, the depth of cut t, the offset amount T, the thread angle A, the retraction diameter d3, and the thread root width W. In this embodiment, the thread being machined is a tapered thread, and the X-axis ending coordinate X1 corresponds to the thread finishing diameter d2; when the tool moves to the X-axis ending coordinate X1, the thread diameter is the thread finishing diameter d2.
[0029] S2. Determine the thread taper by subtracting the thread's X-axis end point coordinate X1 from the thread's X-axis starting point coordinate X0.
[0030] S3, Through Calculate the right limit coordinate T1 of the left and right deflection tools.
[0031] S4. Calculate the left limit coordinate T2 of the left and right deflectors using T2 = -T1.
[0032] S5. The tool moves to the preset feed coordinate. In this embodiment, the feed coordinate is calculated by the lathe programming instructions, which will not be described in detail here.
[0033] S6. The tool moves from the feed coordinate to the Z-axis endpoint coordinate Z1 of the thread as one pass. The first pass moves from the left limit coordinate T2 of the left and right offset coordinates to the right limit coordinate T1.
[0034] S7. Determine whether the current thread machining diameter d4 is equal to the thread finishing diameter d2. If the current thread machining diameter d4 is greater than the thread finishing diameter d2, proceed to S8; if the current thread machining diameter d4 is equal to the thread finishing diameter d2, proceed to S12. The current X-coordinate of the tool corresponds to the current thread machining diameter d4. In this embodiment, after the tool performs one layer of cutting on the thread, the current thread machining diameter d4 is determined by the current X-coordinate of the tool.
[0035] S8. Increase the tool deviation amount T by the current left limit coordinate, and update the left limit coordinate T2a of the next tool movement; determine the right limit coordinate T1a of the next tool movement by the updated left limit coordinate T2a.
[0036] S9. Before the next tool pass, calculate the distance t0 between the current thread machining diameter d4 and the thread finishing diameter d2. Determine if t0 is greater than t. If t0 > t, relative to the previous tool pass, move the tool a distance t towards the thread's X-axis endpoint coordinate X1 along the thread's X-axis direction to adjust the tool's starting point on the X-axis. If t0 < t, relative to the previous tool pass, move the tool a distance t0 towards the thread's X-axis endpoint coordinate X1 along the thread's X-axis direction to adjust the tool's starting point on the X-axis. While moving the tool, calculate the distance t0 between the current thread machining diameter d4 and the thread finishing diameter d2. Adjust the tool's movement distance on the X-axis according to the difference between t0 and t to ensure the tool moves between the thread's X-axis starting point coordinate X0 and the thread's X-axis endpoint coordinate X1. This avoids the problem of over-cutting where the current thread machining diameter d4 is smaller than the thread finishing diameter d2 due to the tool's movement beyond the thread's X-axis endpoint coordinate X1.
[0037] Calculate the distance T3 between the updated left limit coordinate T2a and the updated right limit coordinate T1a, and determine whether T3 is greater than T. If T3 > T, move the tool by a distance T along the Z-axis of the thread to adjust the starting point of the tool on the Z-axis. If T3 < T, move the tool by a distance T3 along the Z-axis of the thread to adjust the starting point of the tool on the Z-axis.
[0038] When moving the tool, calculate the distance T3 between the updated left limit coordinate T2a and the updated right limit coordinate T1a. Adjust the tool's movement distance along the Z-axis according to the size of T3 and T to ensure that the tool moves within the range of the updated left limit coordinate T2a and the updated right limit coordinate T1a, thus avoiding the problem of overcutting caused by the tool's movement exceeding the updated right limit coordinate T1a.
[0039] S10. Determine if the tool has moved to the updated right limit coordinate T1a. If not, repeat S9 to continue moving the tool along the Z-axis direction towards the thread. If yes, proceed to S11.
[0040] S11. Repeat S7-S10 to continue machining the thread until the current thread machining diameter d4 is equal to the thread finishing diameter d2; then proceed to S12.
[0041] S12. The tool moves along the retraction diameter d3 and separates from the workpiece, ending the thread machining.
[0042] The above method cuts the width of the thread along the Z-axis and the depth of the thread along the X-axis. During cutting, the tool first moves along the Z-axis of the thread, performing the first layer of cutting based on the left and right limit coordinates of the cutting tool. Then, the left and right limit coordinates are updated, and the tool moves along the X-axis of the thread, changing the cutting depth on the workpiece. Then, the tool moves from the updated left limit coordinates to the updated right limit coordinates to perform the second layer of cutting. Through the multi-layer movement of the tool, layered cutting of the thread is achieved, reducing the cutting difficulty. Each layer of cutting adopts a straight feed followed by left and right turning. Since the groove depth remains unchanged during left and right cutting, the tool only needs to perform longitudinal feed to the left or right. The cutting method is simple, efficient, and less prone to errors. By cutting layer by layer along the depth of the thread, vibration of each layer of cutting is reduced, thus reducing the generation of chatter marks.
[0043] After each layer of cutting is completed, the left and right limit coordinates are updated. The updated data is used to determine the cutting start and end points of the next layer, thereby controlling the shape of the cut.
[0044] Simultaneously, it can calculate the left and right limit coordinates of the offset tool corresponding to different cutting layers based on preset parameters. The tool moves according to the preset offset amount and depth of cut, which has good reliability. When it is necessary to process threads of different specifications, it is only necessary to change the data of the preset parameters to process threads of different specifications.
[0045] In this embodiment, the diameter d1 of the first thread cutting is greater than the diameter d2 of the thread finishing cut. This avoids interference between the diameter d1 of the first thread cutting and the diameter d2 of the thread finishing cut, so that the tool can achieve the required size of the thread finishing diameter d2 through layer cutting, resulting in high precision.
[0046] In this embodiment, the thread angle A is smaller than the tool angle. This avoids tool marks appearing on the machined thread when the thread angle A is the same as the tool angle, which would affect the surface roughness. By reducing the thread angle A, the surface roughness of the thread is improved.
[0047] The following examples illustrate this: In this embodiment, the offset T is 0.4 mm, and the depth of cut t is 0.4 mm; refer to Figure 2 The left limit coordinates T2 and right limit coordinates T1 of the first tool path are calculated for the first tool path; After the first tool path is completed, the current left limit coordinate is increased by a tool offset amount T, and the left limit coordinate T2a for the next tool path is updated; that is, in the second tool path, the left limit coordinate T2a = T2 + 0.4. Simultaneously, the updated right limit coordinate is determined, and the tool's Z-axis starting point is updated to T2a. At the same time, the tool's depth of cut in the X-axis direction is adjusted, increasing by 0.4 from the thread's X-axis starting point coordinate X0, adjusting the tool's X-axis starting point in the second tool path; then the second tool path is performed. The third tool path is adjusted based on the second tool path.
[0048] In S9, such as Figure 2 As shown, before adjusting the tool to the starting point of the Z-axis, calculate the distance T3 between the updated left limit coordinate T2a and the updated right limit coordinate T1a. If T3 is 0.6, T3 > T, adjust the tool to the starting point of the Z-axis by moving the tool a distance T along the Z-axis direction of the thread; if T3 is 0.2, T3 < T, adjust the tool to the starting point of the Z-axis by moving the tool a distance T3 along the Z-axis direction of the thread.
[0049] In S9, the thread finishing diameter d2 is 25.4, refer to... Figure 2 At point K1, the current thread machining diameter d4 is 26.6, so t0 is 0.6, and t0 > t. At this point, when the tool moves towards the X-axis endpoint, the distance t it moves determines the tool's starting point on the X-axis; the tool's depth of cut is changed; after the tool completes the thread cutting along the current depth of cut, the tool needs to move again, referring to... Figure 2 At point K2, the current thread machining diameter d4 is 26.2, so t0 is 0.2. When t0 < t, the distance t0 that the tool moves to the end point coordinate of the X-axis is adjusted to the starting point of the tool on the X-axis.
Claims
1. A method for machining crane threads using a CNC lathe, characterized in that: Includes the following steps: S1. Preset the thread parameters of the workpiece to be processed. The thread parameters include the standard thread diameter D, the first thread cutting diameter d1, the thread finishing diameter d2, the pitch F, the Z-axis starting coordinate Z0, the Z-axis ending coordinate Z1, the X-axis starting coordinate X0, the X-axis ending coordinate X1, the depth of cut t, the offset amount T, the thread angle A, the retraction diameter d3, and the root width W. S2. Determine the thread taper by subtracting the thread's X-axis end point coordinate X1 from the thread's X-axis starting point coordinate X0. S3, Through Calculate the right limit coordinate T1 of the left and right deflection tools; S4. Calculate the left limit coordinate T2 of the left and right deflection tools using T2 = -T1; S5. The tool moves to the preset feed coordinate; S6. The tool moves from the feed coordinate to the Z-axis endpoint coordinate Z1 of the thread as one pass. The first pass moves from the left limit coordinate T2 of the left and right offset tools to the right limit coordinate T1. The cutting of each layer adopts the turning method of first straight in and then left and right. S7. Determine whether the current thread machining diameter d4 is equal to the thread finishing diameter d2. If the current thread machining diameter d4 is greater than the thread finishing diameter d2, proceed to S8; if the current thread machining diameter d4 is equal to the thread finishing diameter d2, proceed to S12. S8. Increase the tool deviation amount T by the current left limit coordinate, and update the left limit coordinate T2a of the next tool movement; determine the right limit coordinate T1a of the next tool movement by the updated left limit coordinate T2a. S9. Proceed to the next feed. Along the X-axis of the thread, move the tool a distance t towards the X-axis endpoint coordinate X1 to adjust the tool's starting point on the X-axis. Along the Z-axis of the thread, move the tool a distance T to adjust the tool's starting point on the Z-axis, moving from the updated left limit coordinate T2a to the updated right limit coordinate T1a. Calculate the distance T3 between the updated left limit coordinate T2a and the updated right limit coordinate T1a, and determine if T3 is greater than T. If T3 > T, move the tool a distance T along the Z-axis of the thread to adjust the tool's starting point on the Z-axis. If T3 < T, move the tool a distance T3 along the Z-axis of the thread to adjust the tool's starting point on the Z-axis. S10. Determine whether the tool has moved to the updated right limit coordinate T1a. If not, repeat S9 to continue moving the tool along the Z-axis direction of the thread. If yes, proceed to S11. S11. Repeat S7-S10 to continue machining the thread until the current thread machining diameter d4 is equal to the thread finishing diameter d2; then proceed to S12. S12. The tool moves along the retraction diameter d3 and separates from the workpiece, ending the thread machining.
2. The method for machining crane threads using a CNC lathe according to claim 1, characterized in that: The diameter d1 of the first thread cutting is greater than the diameter d2 of the thread finishing cut.
3. A method for machining crane threads using a CNC lathe according to claim 1, characterized in that: The thread angle A is less than the angle of the cutting tool.
Citation Information
Patent Citations
Method for processing coarse-pitch triangular-cone thread
CN102463393B
Method for turning root threads through grooving cutter
CN108672841A
Process for turning large-pitch thread by matching numerical control cutter with macroprogram
CN112404612A
