A simulation method for compression of body-centered cubic lattice with cubic nodes based on beam elements and rigid sheet loading.

By discretizing the diagonal brace into beam elements and the cubic node into rigid blocks, and by applying displacement loads and fixed constraints using rigid sheets, the problems of large computational load, difficulty in convergence, and difficulty in obtaining the rotation angle of the node in the existing technology are solved, thus realizing efficient and accurate lattice compression simulation.

CN123116530APending Publication Date: 2026-11-17GUILIN UNIV OF ELECTRONIC TECH
View PDF 0 Cites 0 Cited by

Patent Information

Application Number
CN202611571285.3
Authority / Receiving Office
CN · China
Patent Type
Applications(China)
Current Assignee / Owner
Filing Date
2026-10-12
Publication Date
2026-11-17

AI Technical Summary

Technical Problem

Existing compression simulation methods suffer from high computational cost, mesh distortion leading to difficulty in convergence, difficulty in directly obtaining node rotation angles, overestimation of the effective length of diagonal members, or lack of clear reference points. End loading causes mixed local deformation and repeated changes in contact state.

Method used

The method of beam element and rigid sheet loading is adopted. The diagonal bar is discretized into beam element and the cubic node is discretized into rigid block. The ends of the beam element and the reference point of the rigid block are connected by rigid multi-point constraint. Displacement load and fixed constraint are applied by rigid sheet to ensure stable contact state. The rotation angle of the node is directly calculated by Newton-Raphson iteration.

Benefits of technology

It significantly reduces the computational load, ensures the convergence of iterative solutions, directly outputs the rotation angle of the node body, avoids overestimation of the length of the diagonal member, ensures uniform load distribution, stable contact state, and accurate calculation results.

✦ Generated by Eureka AI based on patent content.

Smart Images

  • Figure FT_1
    Figure FT_1
  • Figure FT_2
    Figure FT_2
  • Figure FT_3
    Figure FT_3
Patent Text Reader

Abstract

This invention discloses a compression simulation method for a body-centered cubic lattice with cubic nodes based on beam elements and rigid sheet loading, belonging to the field of numerical simulation of lattice structures. The method sets a cubic node at each grid point of the body-centered cubic lattice, discretizes the inclined beam into multiple beam elements, discretizes the cubic node into rigid blocks with reference points, and establishes rigid multi-point constraints between the nodes at the ends of the beam elements and the reference points. A rigid sheet is placed at each end of the loading direction and contact constraints are established with the outer surface of the end cubic node; periodic boundary conditions are applied to the sides. The lower rigid sheet is fixed, and displacement loads are applied to the upper end in incremental steps, solved using Newton-Raphson iteration. The nominal stress and nominal strain are calculated from the reaction force and displacement, and the rotation angle of the node is calculated from the circumferential displacement difference between the two reference points on the upper rigid sheet.
Need to check novelty before this filing date? Find Prior Art

Description

Technical Field

[0001] This invention relates to the field of numerical simulation technology of the mechanical properties of lattice structures, specifically to a compression simulation method for body-centered cubic lattice with cubic nodes based on beam elements and rigid sheet loading. Background Technology

[0002] Lattice structures, characterized by their lightweight, high specific stiffness, and designable deformation capacity, are widely used as load-bearing, energy-absorbing, and buffering components. Body-centered cubic lattices with cubic nodes are one configuration within lattice structures: a cubic node is placed at each lattice point of the lattice, and the body-centered cubic node and the eight corner cubic nodes within the same unit cell are connected by a diagonal rod. Compared to traditional lattices where nodes merely serve as geometric intersections of members, the presence of nodes significantly increases the torsional stiffness at the nodes, eliminates the intersection of the diagonal rod ends, and makes the stress state near the nodes more clearly defined. During the design and selection phase, it is necessary to understand the nominal stress-strain relationship of this type of lattice under compression in a certain direction, as well as the rotation of the nodes during compression; the latter is a key indicator when this type of lattice is used in compression-torsional coupling components.

[0003] Existing compression simulation methods often directly divide the solid geometry of a lattice into three-dimensional solid elements and then apply displacement or pressure to the end face. The problems with this approach are: first, the size difference between the cubic nodal and the inclined rod is significant. To obtain usable stress at the junction of the nodal and the inclined rod, the mesh must be very fine, causing the number of elements and solution time to increase rapidly with the number of unit cells; second, mesh distortion at the junction of the inclined rod and the nodal makes the solution prone to non-convergence; third, the solid element method provides the displacement field for each element. To obtain the rotation angle of the nodal about the loading axis, additional points need to be taken on the nodal and the displacement field needs to be post-processed, making it difficult to directly obtain the rotation of the nodal, the most important quantity.

[0004] If we simplify the diagonal member to a beam element and the node to a rigid block, the number of elements can be reduced by several orders of magnitude, and the rotation angle of the node can be directly given by the rotational displacement of the rigid block reference point. However, this brings two new problems: First, how to connect the ends of the beam elements to the node? If the ends of the beam elements are directly connected to the centroid of the node, the section of the diagonal member within the node is counted repeatedly, the effective length of the diagonal member is overestimated, the flexibility is exaggerated, and the calculation results lose their correspondence with the actual dimensions of the lattice. Second, the dimensions of the node are not negligible relative to the length of the diagonal member, and the position of the rigid block reference point directly affects the correspondence between the displacement of the diagonal member end and the rotation angle of the node. The selection of the reference point must be based on clear criteria.

[0005] The loading method is also a challenge for this type of simulation method. If the surface load or displacement is directly applied to several cubic nodes at the ends, the load is concentrated on a few nodes, and the local deformation at the ends is mixed with the overall deformation of the lattice. The nominal stress calculated from the reaction force includes the local effects at the ends and is therefore distorted. At the same time, the rotation of the end nodes is unrestrained, and during compression, the end nodes will undergo uncontrolled rotation and slippage. The contact state changes repeatedly during the iteration process, and the Newton-Raphson iteration is difficult to converge. If a single solid element is used as the loading plate, additional constraints that do not conform to the actual usage state of the lattice are introduced, and the rotation of the end nodes still cannot be directly read.

[0006] Therefore, a compression simulation method for cube nodes with body-centered cubic lattice based on beam elements and rigid sheet loading is needed. This method discretizes the inclined rod into beam elements and the cube node into rigid blocks. The nodes at the ends of the beam elements are connected to the reference points of the rigid blocks by rigid multi-point constraints, so that the effective length of the inclined rod matches the actual size of the node. The displacement load and fixed constraints are applied to the complete end face by the rigid sheets at both ends, so that the contact state remains unchanged throughout the loading process and the iteration is easy to converge. At the same time, the rotation angle of the node is directly given by the circumferential displacement difference of the reference points on the rigid sheets. Summary of the Invention

[0007] The purpose of this invention is to provide a compression simulation method for cubic lattice with cubic nodes based on beam elements and rigid sheet loading. This method addresses the problems of existing solid element methods, such as large computational load, mesh distortion at the junction leading to poor convergence, difficulty in directly obtaining the rotation angle of the node, overestimation of the effective length of the diagonal rod when the beam element ends are directly connected to the centroid of the node, lack of clear basis for the reference point of the rigid block, and mixed local deformation and repeated changes in contact state caused by end loading.

[0008] To achieve the above objectives, the present invention adopts the following technical solution: a compression simulation method for a body-centered cubic lattice with cubic nodes based on beam elements and rigid sheet loading, comprising the following steps: S1, establishing a geometric model of a body-centered cubic lattice with cubic nodes, setting a cubic node at each grid point of the body-centered cubic lattice, and connecting the body-centered cubic node of the same unit cell to the eight corner cubic nodes by a diagonal rod, with each unit cell periodically arranged in three directions according to the body-centered cubic lattice; S2, discretizing each diagonal rod into multiple beam elements, discretizing each cubic node into a rigid block, each rigid block having a reference point, and connecting the nodes at the ends of the beam elements to the corresponding reference points. S3. Establish rigid multi-point constraints between the points; S4. Place a rigid sheet at each end of the lattice along the loading direction to establish contact constraints between the rigid sheet and the outer surface of the end cube node, and apply periodic boundary conditions on the side perpendicular to the loading direction; S5. Fix the lower rigid sheet, apply displacement load to the upper rigid sheet in incremental steps, and use Newton-Raphson iteration to solve in each incremental step until the unbalanced force meets the convergence criterion; S6. Calculate the nominal stress and nominal strain from the reaction force and displacement of the displacement load, and extract the circumferential displacement difference of the reference point from the two rotation angles on the upper rigid sheet to calculate the rotation angle around the loading axis, and repeat S1 to S4 with a refined mesh to check the mesh convergence.

[0009] Furthermore, the unit cell of the body-centered cubic lattice is a cube with an edge length of a, the eight corner cube nodes are located at the eight vertices of the unit cell, the body-centered cube node is located at the body center of the unit cell, and each diagonal rod extends from the body-centered cube node along a spatial diagonal of the unit cell to the corresponding corner cube node; the angle between the diagonal rod and the loading axis in the unfolded plane is the helix angle β, and satisfies tanβ = √2.

[0010] Furthermore, each diagonal member is divided into at least three beam elements along its own axis. The beam elements are Timoshenko beam elements, and each beam element has a node at both ends. The reference point of each rigid block is located at the centroid of the corresponding cubic node. The rigid block has three translational degrees of freedom and three rotational degrees of freedom. The rigid multi-point constraint is established by the following formula: u_node = u_ref + θ_ref × r, where r is the position vector from the reference point to the node.

[0011] Furthermore, the rigid sheet and the outer surface of the end cube node are in bonded contact. The rigid sheet is a rigid body, and each point on it retains only one translational degree of freedom along the loading direction. The periodic boundary condition is: take each pair of nodes with corresponding positions on two opposite sides, let the displacement difference of the pair of nodes be equal to the product of the macroscopic displacement gradient and the position vector between the pair of nodes, and the rotational displacement of the pair of nodes be equal.

[0012] Furthermore, the nominal stress is the reaction force divided by the initial cross-sectional area of ​​the lattice perpendicular to the loading direction, and the nominal strain is the axial displacement removed by the initial height of the lattice along the loading direction; the rotation angle is determined by the following formula: φ = Δu / r, where Δu is the circumferential displacement difference between the two rotation reference points on the upper rigid sheet, and r is the distance from the two rotation reference points to the loading axis; the mesh convergence is judged by the relative deviation of the nominal stress-nominal strain curves under two adjacent meshes being less than 2%.

[0013] The present invention also provides a compression simulation system for a body-centered cubic lattice with cubic nodes based on beam elements and rigid sheet loading, including a geometric modeling module, an element division module, a loading and boundary condition module, a solution module and a result extraction module, which are respectively used to execute S1 to S5 in the above method.

[0014] Compared with existing technologies, the beneficial effects of this invention are as follows: First, by discretizing the inclined rod into beam elements and the cubic node into rigid blocks, the large number of elements in the three-dimensional solid element are replaced by a small number of beam elements and rigid blocks, significantly reducing the computational load. Simultaneously, the rotation angle of the node can be directly output from the rotational displacement of the rigid block reference point, eliminating the need for post-processing of the displacement field. Second, a rigid multi-point constraint is established between the node at the end of the beam element and the reference point of the rigid block, instead of directly connecting the end of the beam element to the centroid of the node. Therefore, the section of the inclined rod located within the node is not repeatedly counted, the effective length of the inclined rod matches the actual size of the node, the flexibility of the inclined rod is not overestimated, and the calculation results maintain a correspondence with the actual size of the lattice. Third, with the reference point located at the centroid of the cubic node, the rotation of the rigid block occurs around the centroid, and the correspondence between the displacement of the inclined rod end and the rotation angle of the node has a clear geometric basis, eliminating the need to select the reference point position based on experience. Fourth, by applying displacement loads and fixed constraints to the complete end face using rigid plates at both ends, the load is no longer concentrated on a few cubic nodes. The local deformation at the ends is separated from the overall deformation of the lattice, and the nominal stress remains undistorted. Since the rigid plates are rigid bodies, the rotation and slippage of the end cubic nodes are constrained by the rigid plates, and the contact state remains unchanged throughout the loading process, making the Newton-Raphson iteration easy to converge. Fifth, the nodes on the rigid plates retain only one translational degree of freedom along the loading direction. The circumferential displacement of the reference point for rotation extraction directly gives the rotation angle of the end node, eliminating the need to construct a separate measuring device in the model. Sixth, the periodic boundary conditions eliminate the influence of the lateral free boundaries, making the obtained nominal stress-strain relationship close to the stress state of the lattice inside the component. Attached Figure Description

[0015] Figure 1 This is a schematic diagram of the body-centered cubic lattice unit cell geometric model containing cubic nodes of the present invention;

[0016] Figure 2 This is a schematic diagram of the discrete beam element and rigid coupling of the unit cell of the present invention, wherein (a) is a schematic diagram of the discrete beam element after the unit cell is cut along a spatial diagonal plane, and (b) is a schematic diagram of the rigid coupling between the cube node and the end of the beam element.

[0017] Figure 3 This is a flowchart of the compression simulation method of the present invention;

[0018] Figure 4 This is a schematic diagram of the rigid sheet loading, boundary conditions and calculation results of the present invention, wherein (a) is a front view of the rigid sheet loading and boundary conditions, (b) is the nominal stress-nominal strain curve, and (c) is the node rotation angle-nominal strain curve.

[0019] In the figure: 1—unit cell edge; 2—corner cube node; 3—body-centered cube node; 4—diagonal bar; 5—beam element; 6—node at the end of the beam element; 7—rigid body reference point; 8—rigid multi-point constraint; 9—rigid sheet; 10—displacement load; 11—fixed constraint; 12—periodic boundary condition; 13—corner extraction reference point. Detailed Implementation

[0020] The present invention will be further described below with reference to the accompanying drawings and specific embodiments.

[0021] like Figure 1 As shown, the simulated body-centered cubic lattice with cubic nodes in this embodiment is composed of multiple unit cells arranged periodically along three directions. Each unit cell is a cube with an edge length of a. Each of the eight vertices of the unit cell has a corner cube node (2), and the body-centered cubic node (3) is located at the body center of the unit cell. The body-centered cubic node (3) and the eight corner cube nodes (2) are connected by a diagonal rod (4), and the axis of each diagonal rod (4) coincides with a spatial diagonal of the unit cell. The cube node is a cube with an edge length of 0.25 to 0.4 times a; in this embodiment, a is taken as 10 mm, and the edge length of the cube node is taken as 3 mm. Figure 1 The edge (1) of the unit cell indicated by the dashed line in the middle is the geometric boundary of the unit cell, used to mark the range and size of the unit cell, and is not a component itself.

[0022] If the inclined rod (4) is unfolded along a generatrix on the cylindrical surface containing its own axis, then the inclined rod (4) is a straight line segment on the unfolded surface. The angle between this straight line segment and the loading axis is the helix angle β of the inclined rod (4). Since the inclined rod (4) extends from the body center of the unit cell to one vertex of the unit cell, the projected length of the inclined rod (4) along the loading axis is equal to a / 2, and its circumferential projected length is equal to a / √2. Therefore, the helix angle satisfies tanβ =√2, that is, β is approximately 54.7°.

[0023] like Figure 2 As shown in (a), this figure is a cross-sectional view of the unit cell after being cut along a diagonal plane containing its two body diagonals. The four corner cube nodes (2), the body-centered cube node (3), and the four diagonal rods (4) connecting them are all located within this diagonal plane. The square with the section line represents the cube node that is cut, and the dashed line represents the cross-sectional outline of the unit cell on this diagonal plane. Each diagonal rod (4) is divided into multiple beam units (5) along its own axis, and each beam unit (5) has a node (6) at each end. The beam unit (5) adopts the Timoshenko beam unit, that is, it simultaneously considers bending deformation and shear deformation. In this embodiment, each diagonal rod (4) is divided into four beam units (5). The cross-section of the beam unit (5) is circular, and its diameter is one-third of the edge length of the cube node to ensure that the end of the diagonal rod (4) falls completely within the cube node.

[0024] like Figure 2 As shown in (b), each of the cubic nodes is discretized into rigid blocks. The rigid blocks are non-deformable and have a reference point (7) located at the centroid of the corresponding cubic node. The rigid blocks have three translational degrees of freedom and three rotational degrees of freedom. The cubic nodes can be discretized into rigid blocks because their edge length is sufficiently small compared to the length of the inclined rod (4), and their deformation during compression is much smaller than the bending deformation of the inclined rod (4). Using rigid blocks also ensures that the torsional stiffness at the nodes is not underestimated, which is consistent with the fact that the cubic nodes themselves have a large torsional stiffness.

[0025] like Figure 2 As shown in (b), a rigid multi-point constraint (8) is established between the node (6) at the end of the beam element (5) and the corresponding reference point (7). The rigid multi-point constraint (8) is established by the following formula:

[0026] u_node = u_ref + θ_ref × r

[0027] In the formula, u_node is the translational displacement vector of the node (6), u_ref is the translational displacement vector of the reference point (7), θ_ref is the rotational displacement vector of the reference point (7), and r is the position vector from the reference point (7) to the node (6). The meaning of the rigid multi-point constraint (8) is that the displacement of the node (6) at the end of the beam element (5) is completely determined by the translation and rotation of the reference point (7), and the node (6) no longer has an independent degree of freedom. In this way, the bending moment and torque transmitted by the inclined rod (4) to the cube node body are transmitted to the rigid block through the node (6) and the reference point (7), and the rotation of the cube node body is given by the rotational displacement of the reference point (7), without the need for post-processing of the displacement field.

[0028] like Figure 4 As shown in (a), a rigid sheet (9) is provided at each end of the lattice along the loading direction. The lower surface of the upper rigid sheet (9) is attached to the upper surface of the uppermost corner cube node (2), and the upper surface of the lower rigid sheet (9) is attached to the lower surface of the lowermost corner cube node (2). A contact constraint is established between the rigid sheet (9) and the outer surface of the end cube node. In this embodiment, the contact constraint is a binding contact, that is, the nodes on the outer surface and the reference points of the rigid sheet (9) maintain the aforementioned rigid multi-point constraint, and relative slippage and relative separation are not allowed between them. The rigid sheet (9) is a rigid body, and its own deformation can be ignored. Each point on it retains only one translational degree of freedom along the loading direction.

[0029] like Figure 4 As shown in (a), periodic boundary conditions (12) are applied to the four sides perpendicular to the loading direction. The periodic boundary condition (12) means that for each pair of nodes with corresponding positions on two opposite sides, the displacement difference of the pair of nodes is equal to the product of the macroscopic displacement gradient and the position vector between the pair of nodes, and the rotational displacement of the pair of nodes is equal. The periodic boundary condition (12) makes the simulated lattice equivalent to a representative volume element in an infinite lattice, thereby eliminating the influence of the side free boundary on the nominal stress-nominal strain relationship.

[0030] like Figure 4 As shown in (a), a fixed constraint (11) is applied to the rigid sheet (9) at the lower end, so that all degrees of freedom of the rigid sheet are zero. Figure 4In (a), the diagonal line below the fixed constraint (11) is used to represent the load. A displacement load (10) is applied to the upper rigid sheet (9), which points downward along the loading direction and increases in increments. Since the rigid sheet (9) is a rigid body and each point on it retains only one translational degree of freedom, the displacement load (10) applied to the rigid sheet (9) is equivalent to being uniformly applied to the entire upper surface. The cubic nodes at the ends will not experience uncontrolled rotation or slippage, and the contact state remains unchanged throughout the loading process.

[0031] The solution within each increment step employs Newton-Raphson iteration: using the displacement at the convergence of the previous increment step as the initial value, the overall stiffness matrix and unbalanced force vector are assembled, the increment displacement is solved, the displacement is updated, and the unbalanced force is recalculated until the ratio of the L2 norm of the unbalanced force to the L2 norm of the current reaction force is less than one ten-thousandth. If the convergence criterion is not met within the set upper limit of the number of iterations, the step size of the increment step is reduced by a set ratio and the solution is recalculated. Since the rigid multi-point constraint (8) has eliminated the degrees of freedom of the node (6) and the contact relationship remains unchanged during the solution process, the convergence of the iteration does not deteriorate due to the repeated changes in the contact state.

[0032] The nominal stress and nominal strain are calculated from the reaction force and displacement of the displacement load (10): the nominal stress is the reaction force divided by the initial cross-sectional area of ​​the lattice perpendicular to the loading direction, and the nominal strain is the axial displacement generated by the displacement load (10) removed to the initial height of the lattice along the loading direction.

[0033] like Figure 4 As shown in (a), two reference points (13) are taken on the top surface of the rigid sheet (9) at the upper end. The distances from these two reference points to the loading axis are equal and both are r, and their circumferential displacement difference is Δu. Since the rigid sheet (9) is a rigid body, its rotation angle φ around the loading axis is determined by the following formula:

[0034] φ = Δu / r

[0035] Figure 4 In (a) of the model, an arc arrow centered on the loading axis is drawn on the top surface of the rigid sheet (9), indicating the direction of rotation of the rigid sheet (9) around the loading axis. Since the rigid sheets (9) at the upper and lower ends are respectively bound to the end cube nodes, the φ obtained from the above formula is the rotation angle of the end cube node relative to the lower cube node, and there is no need to construct a separate measuring device in the model.

[0036] Repeat the above steps with the encrypted mesh to check the mesh convergence: double the number of beam elements (5) on each of the inclined rods (4) while keeping the edge length of the cube node unchanged, and recalculate; when the relative deviation of the nominal stress-nominal strain curves obtained under two adjacent meshes at the same nominal strain is less than 2%, the mesh is determined to be convergent, and the result at this time is not related to the density of the mesh.

[0037] like Figure 4 As shown in (b), the nominal stress-nominal strain curve obtained from the above steps becomes steeper and gentler as the nominal strain increases, that is, the lattice has a higher nominal tangential modulus in the early stage of compression, and then gradually becomes gentler due to the bending and buckling of the inclined rod (4). Figure 4 As shown in (c), the rotation angle of the end cubic node increases approximately linearly with the nominal strain, and its slope is the angular magnification of the lattice. Figure 4 (b) and Figure 4 In (c), the dashed line represents the result obtained using a coarser grid, and the solid line represents the result obtained using a finer grid. The difference between the two decreases as the grid is finer, which indicates that the grid converges. Figure 4 (b) and Figure 4 The curve in (c) is a schematic curve, and its specific value shall be based on the actual calculation result according to the aforementioned steps.

[0038] In this embodiment, the edge length of the cube node, the number and cross-sectional dimensions of the beam elements (5), the step size of the incremental step, and the threshold of the convergence criterion are all designed values. The actual values ​​are based on the results calculated and verified according to the above steps. The edge length of the cube node and the cross-sectional dimensions of the inclined rod (4) should ensure that the end of the inclined rod (4) falls completely inside the cube node. This condition should be verified when determining the values.

[0039] As an alternative implementation, the beam element (5) can be an Euler-Bernoulli beam element; the number of beam elements (5) equally divided by each of the diagonal bars (4) can be more than three, and the number is determined according to the length-to-diameter ratio of the diagonal bars (4) and the required accuracy. As an alternative implementation, the rigid sheet (9) and the outer surface of the end cubic node can adopt a small sliding contact, that is, allow tangential relative sliding while restricting normal mutual embedding; at this time, the end cubic node may rotate slightly during compression, and the reading of the rotation angle extraction reference point (13) should be corrected accordingly. As an alternative implementation, the cubic node can be discretized into a combination of a rigid block and a shell element located on the surface of the rigid block, so as to reflect its local surface deformation while retaining the overall stiffness of the node. As an alternative implementation, the loading method can be changed to apply a force load on the rigid sheet (9) and solve it using the arc length method, thereby obtaining the descending segment of the nominal stress-nominal strain curve. As an alternative implementation, the materials of the cubic node and the inclined rod (4) can be thermoplastic polyurethane, nylon, photosensitive resin, aluminum alloy or titanium alloy, and the materials are input in the simulation with the corresponding constitutive model.

Claims

1. A simulation method for compression of body-centered cubic lattice with cubic nodes based on beam elements and rigid sheet loading, characterized in that, Includes the following steps: S1. Establish a geometric model of a body-centered cubic lattice containing cubic nodes. Set a cubic node at each grid point of the body-centered cubic lattice. The body-centered cubic node (3) of the same unit cell is connected to the eight corner cubic nodes (2) by a diagonal rod (4). Each unit cell is arranged periodically in three directions according to the body-centered cubic lattice. S2. Discretize each of the inclined rods (4) into multiple beam elements (5), discretize each of the cube nodes into rigid blocks, each of the rigid blocks is provided with a reference point (7), and establish rigid multi-point constraints (8) between the nodes (6) at the ends of the beam elements (5) and the corresponding reference points (7). S3. A rigid sheet (9) is provided at each end of the lattice along the loading direction, so that the rigid sheet (9) and the outer surface of the end cube node are established to form a contact constraint, and a periodic boundary condition (12) is applied on the side perpendicular to the loading direction. S4. Fix the rigid sheet (9) at the lower end, and apply displacement load (10) to the rigid sheet (9) at the upper end in incremental steps. In each incremental step, Newton-Raphson iteration is used to solve the problem until the unbalanced force satisfies the convergence criterion. S5. Calculate the nominal stress and nominal strain from the reaction force and displacement of the displacement load (10), and calculate the rotation angle around the loading axis from the circumferential displacement difference of the reference point (13) extracted from the two rotation angles on the upper rigid sheet (9). Then repeat S1 to S4 according to the encrypted mesh to check the mesh convergence.

2. The compression simulation method for a body-centered cubic lattice with cubic nodes according to claim 1, characterized in that, The unit cell of the body-centered cubic lattice is a cube with an edge length of a. The eight corner cube nodes (2) are located at the eight vertices of the unit cell. The body-centered cubic node (3) is located at the body center of the unit cell. Each diagonal rod (4) extends from the body-centered cubic node (3) along a spatial diagonal of the unit cell to the corresponding corner cube node (2). The angle between the inclined rod (4) and the loading axis in the unfolded surface obtained by unfolding the cylindrical surface containing its own axis along a generatrix is ​​the helix angle β, and the helix angle satisfies tanβ = √2; The projected length of the diagonal bar (4) along the loading axis is equal to a / 2, and its projected length along the circumferential direction is equal to a / √2.

3. The compression simulation method for a volume-centered cubic lattice with cubic nodes according to claim 1, characterized in that, Each of the diagonal bars (4) is divided into at least three beam units (5) along its own axis. The beam unit (5) is a Timoshenko beam unit, and each of the beam units (5) has a node (6) at each end. The cross-section of the beam unit (5) is circular, and its diameter is smaller than the edge length of the cube node, so that the end of the diagonal rod (4) falls completely into the cube node.

4. The compression simulation method for a body-centered cubic lattice with cubic nodes according to claim 1, characterized in that, The reference point (7) of each rigid block is located at the centroid of the corresponding cube node, and the rigid block has three translational degrees of freedom and three rotational degrees of freedom; The rigid multi-point constraint (8) is established by the following formula: u_node = u_ref + θ_ref × r, where u_node is the translational displacement vector of the node (6), u_ref is the translational displacement vector of the reference point (7), θ_ref is the rotational displacement vector of the reference point (7), and r is the position vector from the reference point (7) to the node (6).

5. The compression simulation method for a volume-centered cubic lattice with cubic nodes according to claim 1, characterized in that, The contact constraint between the rigid sheet (9) and the outer surface of the end cube node body is a binding contact, that is, the node on the outer surface and the reference point of the rigid sheet (9) maintain the rigid multi-point constraint (8), and the rigid sheet (9) and the end cube node body are not allowed to slide or separate relative to each other. The rigid sheet (9) is a rigid body, and each point on it retains only one translational degree of freedom along the loading direction.

6. The compression simulation method for a body-centered cubic lattice with cubic nodes according to claim 1, characterized in that, The periodic boundary condition (12) is: take each pair of nodes with corresponding positions on two opposite sides perpendicular to the loading direction, and let the displacement difference of the pair of nodes be equal to the product of the macroscopic displacement gradient and the position vector between the pair of nodes. Furthermore, the rotational displacements of the pair of nodes are equal.

7. The compression simulation method for a volume-centered cubic lattice with cubic nodes according to claim 1, characterized in that, The nominal stress is the reaction force of the displacement load (10) divided by the initial cross-sectional area of ​​the lattice perpendicular to the loading direction, and the nominal strain is the axial displacement removed by the displacement load (10) to the initial height of the lattice along the loading direction; The rotation angle is determined by the following formula: φ = Δu / r, where Δu is the circumferential displacement difference between the two rotation angle extraction reference points (13) on the upper rigid sheet (9), and r is the distance from the two rotation angle extraction reference points (13) to the loading axis.

8. The compression simulation method for a volume-centered cubic lattice with cubic nodes according to claim 1, characterized in that, The convergence criterion for the Newton-Raphson iteration is that the ratio of the L2 norm of the unbalanced force to the L2 norm of the current reaction force is less than one part in ten thousand. If the convergence criterion is not met even after the number of iterations in a certain increment step reaches the set upper limit, the step size of the increment step is reduced by a set ratio and the solution is solved again.

9. The compression simulation method for a volume-centered cubic lattice with cubic nodes according to claim 1, characterized in that, When repeating S1 to S4 in S5 according to the encrypted grid, double the number of beam units (5) on each of the inclined rods (4) and keep the edge length of the cube node unchanged; The mesh is considered convergent when the relative deviation of the nominal stress-nominal strain curves obtained from two adjacent meshes at the same nominal strain is less than 2%.

10. A simulation system for compression of a body-centered cubic lattice with cubic nodes based on beam elements and rigid sheet loading, characterized in that, include: The geometric modeling module is used to establish a geometric model of a body-centered cubic lattice containing cubic nodes. A cubic node is set at each grid point of the body-centered cubic lattice, and the body-centered cubic node (3) of the same unit cell and the eight corner cubic nodes (2) are connected by a diagonal rod (4). The unit division module is used to discretize each of the inclined rods (4) into multiple beam units (5), discretize each of the cube nodes into rigid blocks with reference points (7), and establish rigid multi-point constraints (8) between the nodes (6) at the ends of the beam units (5) and the corresponding reference points (7). The loading and boundary condition module is used to set a rigid sheet (9) at each end of the lattice along the loading direction and establish contact constraints between the sheet and the outer surface of the end cube node, and to apply periodic boundary conditions (12) on the side perpendicular to the loading direction. The solution module is used to fix the rigid sheet (9) at the lower end, apply displacement load (10) to the rigid sheet (9) at the upper end in incremental steps, and solve the problem using Newton-Raphson iteration in each incremental step. The result extraction module is used to calculate the nominal stress and nominal strain from the reaction force and displacement, and to calculate the rotation angle around the loading axis from the circumferential displacement difference of the reference point (13) at the two rotation angles on the upper rigid sheet (9).