Loading method for CAE transient fatigue analysis of vehicle under multiple working conditions

By integrating the vehicle multi-condition CAE transient fatigue analysis loading program in HyperMesh in the CAE pre-processing software, automatic load processing and analysis steps, the problems of poor load loading versatility and complex file management in the existing technology are solved, and the rapid and Accurate CAE transient fatigue analysis of multi-conditions of the whole vehicle significantly improves efficiency and accuracy.

CN113591219BActive Publication Date: 2024-11-15CHONGQING CHANGAN AUTOMOBILE CO LTD
View PDF 0 Cites 0 Cited by

Patent Information

Application Number
CN202110865408.5
Authority / Receiving Office
CN · China
Patent Type
Patents(China)
Current Assignee / Owner
Filing Date
2021-07-29
Publication Date
2024-11-15
Estimated Expiration
2041-07-29

AI Technical Summary

Technical Problem

When performing the transient fatigue analysis of CAE in the vehicle multi-condition CAE, the header file reference method is poor in versatility and the number of files is large, resulting in large workload, long time-consuming and error-prone, making it difficult to achieve fast and accurate load loading.

Method used

Integrate the vehicle multi-condition CAE transient fatigue analysis loader in the HyperMesh panel of the CAE pre-processing software, import the basic mesh model, create cards and load sets, generate analysis steps, and split the modal coordinate files to realize load loading and automation and unified management of analysis steps.

Benefits of technology

It greatly improves model preprocessing efficiency, enables the creation of all reliability road transient loading steps in 30 minutes, simplifies file management and calculation processes, and reduces error rates and time-consuming.

✦ Generated by Eureka AI based on patent content.

Smart Images

  • Figure CN113591219B_ABST
    Figure CN113591219B_ABST
Patent Text Reader

Abstract

The present invention discloses a whole vehicle multi-operating condition CAE transient fatigue analysis loading method, comprising: step 1, integrating the whole vehicle multi-operating condition CAE transient fatigue analysis loading program in the CAE pre-processing software HyperMesh panel; step 2, importing the CAE basic mesh model of the whole vehicle transient fatigue analysis in the CAE pre-processing software HyperMesh, and completing the creation of counterweights and attachment points; step 3, selecting all operating condition load files, creating cards and load sets Load Collectors required for the whole vehicle CAE transient fatigue analysis stress calculation; step 4, creating the analysis steps Load Steps required for the whole vehicle CAE transient fatigue analysis stress calculation according to the cards and load sets Load Collectors; step 5, exporting the whole vehicle CAE transient fatigue analysis stress calculation file, obtaining the modal stress op2 file and the total modal coordinate pch master file; step 6, splitting the modal coordinate pch master file into modal coordinate pch sub-files of multiple independent operating conditions. The present invention solves the problems of poor universality and large number of files in the header file reference method.
Need to check novelty before this filing date? Find Prior Art

Description

Technical Field

[0001] The present invention belongs to the technical field of automobile computer-aided design, and in particular relates to a loading method for multi-working-condition CAE transient fatigue analysis of a whole vehicle. Background Art

[0002] During automotive R&D, reliability road test conditions fully simulate user scenarios and road conditions, making them one of the most critical verification steps in the R&D process. CAE simulation methods are often used in the early stages of R&D to simulate road test conditions, shortening the R&D cycle and reducing R&D costs.

[0003] Common CAE simulations use quasi-static fatigue methods for vehicle fatigue calculations. These methods are highly efficient and can identify cracking risks in medium- and high-frequency vehicle body parts. However, to identify low-frequency risks, such as those in engine compartment components, a more effective method is transient fatigue analysis. Transient fatigue analysis offers high accuracy, can identify cracking risks caused by resonance, and can also cover quasi-static fatigue methods.

[0004] A commonly used transient fatigue analysis method in engineering is the linear modal superposition method, which is characterized by its high efficiency. Transient fatigue analysis consists of two processes: stress calculation and fatigue calculation. During the reliability road multi-condition stress calculation process, creating analysis steps is time-consuming and prone to errors. Taking the stress calculation for transient fatigue analysis of a passenger vehicle as an example: the vehicle body has 20 attachment points, and the reliability road transient load files total 40. In HyperMesh, over 13,000 load collectors and 41 analysis steps must be created. Existing technologies rarely describe the loading of transient fatigue analysis road spectrum loads. For example, patent document CN112395727A discloses a CAE-based method and device for creating vehicle durability conditions. This method inputs and parses condition load data table information to load selected component nodes. This method is not suitable for loading transient fatigue loads on the vehicle under multiple conditions of varying duration. Manual implementation is labor-intensive and requires at least 24 hours. A commonly used method in engineering is to use header files to reference load files to perform stress calculations. Its disadvantage is poor versatility. Different vehicle models require separate modification of header files. The modification process is time-consuming and prone to errors. In addition, the calculation involves many files, which is inconvenient for file management and transmission.

[0005] Therefore, it is necessary to develop a loading method for CAE transient fatigue analysis of the entire vehicle under multiple working conditions. Summary of the Invention

[0006] The purpose of the present invention is to provide a vehicle multi-working condition CAE transient fatigue analysis loading method to solve the problems of poor versatility and large number of files in the header file reference method.

[0007] The present invention provides a vehicle multi-operating condition CAE transient fatigue analysis loading method, comprising the following steps:

[0008] Step 1: Integrate the vehicle multi-condition CAE transient fatigue analysis loader into the CAE pre-processing software HyperMesh panel;

[0009] Step 2: Import the CAE basic mesh model for vehicle transient fatigue analysis into the CAE pre-processing software HyperMesh, create the counterweight and attachment points, and run the vehicle multi-condition CAE transient fatigue analysis loader.

[0010] Step 3. Select all load files and create the cards and load collectors required for the stress calculation of the vehicle CAE transient fatigue analysis.

[0011] Step 4. Create the load steps required for the stress calculation of the vehicle CAE transient fatigue analysis based on the cards and load collectors.

[0012] Step 5: Export the vehicle CAE transient fatigue analysis stress calculation file to obtain the modal stress op2 file and the total modal coordinate pch master file;

[0013] Step 6: Use the transient fatigue analysis loader to split the modal coordinate pch main file into multiple modal coordinate pch sub-files for independent working conditions.

[0014] Optionally, in step 1, the vehicle multi-condition CAE transient fatigue analysis loader is used to parse the condition load bdf file with the content in TABLED1 format, and then complete the load loading, analysis type setting, result output setting, analysis step creation, and modal coordinate pch main file splitting in the pre-processing software HyperMesh.

[0015] Optionally, in step 2, the CAE basic mesh model includes a mesh model of the entire vehicle structure and its connection relationship; the CAE basic mesh model needs to be weighted as required to meet the calculation requirements; and the numbering of the created attachment points must be consistent with the load node numbering in the working condition load bdf file in step 1.

[0016] Optionally, in step 3, according to the reliability road test working condition, the isotropic loads of the vehicle body attachment points are obtained through multi-body dynamic simulation analysis, and the loads are time domain loads; all working condition load files are selected and imported in the pre-processing software HyperMesh software, the working condition load files are bdf files, and the format of the working condition load file content is TABLED1; the load information of the working condition load file is parsed, and the parsed content includes: attachment point number, load direction and load history; if the check passes, the cards and load sets Load Collectors required for the calculation are created according to the input load, the card content includes analysis type and result output control, and the load set Load Collectors includes DAREA, TABLED1, TLOAD1, DLOAD, TSTEP, TABDMP1, and EIGRL load parameters required by the Nastran software SOL112 solver; if the check fails, exit, modify the CAE mesh model according to the prompts, and rerun the load loading program until the load is successfully loaded.

[0017] Optionally, in step 4, the analysis step Load Steps includes the modal SOL112 modal analysis step and each working condition analysis step. The name of each working condition analysis step is consistent with the working condition load file name selected in step 3, which is convenient for distinguishing and identifying working conditions. The program will determine whether the input load is multiple working conditions. If it is not multiple working conditions, the load loading process is completed. If it is multiple working conditions, analysis steps for other working conditions are created until the creation of all working condition analysis steps Load Steps is completed.

[0018] Optionally, in step 5, a calculation file containing all loads and analysis steps is exported, and the SOL112 solver of the finite element software Nastran is used for calculation to obtain a modal stress op2 file and a modal coordinate pch master file containing all working conditions.

[0019] Optionally, in step 6, a transient fatigue analysis loader is used to split the modal coordinate pch main file of step 5 into modal coordinate pch sub-files of multiple independent working conditions for subsequent fatigue calculations.

[0020] The present invention has the following advantages: it can quickly load all reliability road transient loads into the vehicle CAE basic grid model and establish a complete calculation file, realizing the inclusion of all load analysis steps in one model file, facilitating subsequent splitting, management and calculation. The entire loading process does not exceed 30 minutes, greatly improving the efficiency of model pre-processing. BRIEF DESCRIPTION OF THE DRAWINGS

[0021] Figure 1 is a flow chart of this embodiment;

[0022] Figure 2 This is a flowchart of the multi-operating condition analysis step creation in this embodiment. DETAILED DESCRIPTION

[0023] The present invention will be further described below with reference to the accompanying drawings.

[0024] In this embodiment, a method for loading a vehicle multi-operating-condition CAE transient fatigue analysis includes the following steps:

[0025] Step 1: Integrate the vehicle multi-condition CAE transient fatigue analysis loader into the HyperMesh panel of the CAE (Computer Aided Engineering) pre-processing software. The details are as follows:

[0026] A vehicle-wide multi-condition CAE transient fatigue analysis loader was developed using Tcl / Tk (Tcl / Tk is an engineering control language. Tk is a powerful graphical toolbox within Tcl that allows for rapid development of graphical interfaces and is widely used in engineering). This loader parses load condition bdf files (TABLED1 format) and then completes load loading, analysis type settings, result output settings, and analysis step creation within the pre-processing software HyperMesh. The loader also features the ability to split modal coordinate pch master files and is integrated into the HyperMesh panel.

[0027] Step 2: Import the CAE basic mesh model for vehicle transient fatigue analysis into the CAE pre-processing software HyperMesh, create the counterweight and attachment points, and run the vehicle multi-condition CAE transient fatigue analysis loader; the details are as follows:

[0028] Import the CAE base mesh model for the vehicle transient fatigue analysis, including the mesh model of the vehicle's structural components and their connections, including welds, weld seams, and adhesives. Balancing the vehicle as required to meet the calculation requirements is performed. Create vehicle attachment points, numbering them to match the load node numbers in the load case bdf file described in Step 1, to form the final CAE mesh model. These attachment points are used for load transfer and are located at the junction of the body and chassis.

[0029] Step 3. Select all load files and create the cards and load collectors required for the stress calculation of the vehicle CAE transient fatigue analysis. The details are as follows:

[0030] According to the reliability road test conditions, the axial loads on the vehicle body attachment points are obtained through multi-body dynamic simulation analysis. The loads are time domain loads. Each working condition saves and outputs an independent working condition load file. The working condition load file is a bdf file, and the format of the load content is TABLED1. The name format of the load name of each attachment point in the load file is: attachment point number (4 digits) + load direction (numbers 1-6, representing 6-directional loads respectively). For example, 10011 represents the X-direction load of the attachment point number 1001. After selecting and importing all working condition load files in the pre-processing software HyperMesh, as shown Figure 2 As shown, step S31 parses the load information in the load case file, including the attachment point number, load direction, and load history. Step S32 retrieves the attachment point number of the CAE mesh model. Step S33 checks whether the load attachment point number matches the CAE mesh model's attachment point number. If the check passes, the program creates the required load collectors and cards based on the input loads. If the check fails, the program exits, and the CAE mesh model is modified according to the program prompts. The load loading program is then rerun until the load is successfully loaded.

[0031] like Figure 2 As shown, after the attachment point number matching check passes, the loader completes the setup of the cards required for transient fatigue analysis stress calculations in step S34. Cards contain analysis types and result output controls. Load Collectors are created through steps S34, S35, and S36. These Load Collectors include the DAREA, TABLED1, TLOAD1, DLOAD, TSTEP, TABDMP1, and EIGRL load parameters required by the Nastran SOL112 solver.

[0032] Step 4. Create the load steps required for the stress calculation of the vehicle CAE transient fatigue analysis based on the cards and load collectors. The details are as follows:

[0033] like Figure 2As shown, according to the cards and load collectors in step 3, the analysis steps Load Steps required for transient fatigue analysis stress calculation are created through step S37. Among them, the analysis steps Load Steps include the modal SOL112 modal analysis step and the actual working condition analysis step. The name of each working condition analysis step is consistent with the working condition load file name selected in step 3, which is convenient for distinguishing and identifying working conditions. Step S38 determines whether the input load is multiple working conditions. If it is not multiple working conditions, the load loading process is completed. If it is multiple working conditions, steps S35, S36 and S37 are repeated to create analysis steps for other working conditions until the creation of analysis steps Load Steps for all working conditions is completed.

[0034] Step 5: Export the vehicle CAE transient fatigue analysis stress calculation file to obtain the modal stress op2 file and the total modal coordinate pch master file; the details are as follows:

[0035] Export the calculation file (bdf file) containing all loads and analysis steps, which can be directly used for calculation in the SOL112 solver of the finite element software Nastran to obtain the modal stress op2 file and the modal coordinate pch master file containing all working conditions.

[0036] Step 6: Use the transient fatigue analysis loader to split the modal coordinate pch main file into multiple modal coordinate pch sub-files for independent working conditions; the details are as follows:

[0037] Use the transient fatigue analysis loader described in step 1 to split the modal coordinate pch main file of step 5 into modal coordinate pch sub-files of multiple independent working conditions for subsequent fatigue calculations.

Claims

1. A vehicle multi-operating condition CAE transient fatigue analysis loading method, characterized in that: The following steps are involved: Step 1: Integrate the vehicle multi-condition CAE transient fatigue analysis loader into the CAE pre-processing software HyperMesh panel; Step 2: Import the CAE basic mesh model of the vehicle transient fatigue analysis into the CAE pre-processing software HyperMesh, complete the creation of counterweights and attachment points, and run the vehicle multi-condition CAE transient fatigue analysis loading program; Step 3. Select all load files and create the cards and load collectors required for the stress calculation of the vehicle CAE transient fatigue analysis; specifically: According to the reliability road test conditions, the isotropic loads at the vehicle body attachment points are obtained through multi-body dynamic simulation analysis, and the loads are time domain loads; all working condition load files are selected and imported in the pre-processing software HyperMesh, and the working condition load files are bdf files, and the format of the working condition load file content is TABLED1; Parse the load information of the load file, including the attachment point number, load direction and load history. If the check is passed, create the cards and load collectors required for the calculation according to the input load. The card content includes the analysis type and result output control. The load collectors include the DAREA, TABLED1, TLOAD1, DLOAD, TSTEP, TABDMP1 and EIGRL load parameters required by the Nastran software SOL112 solver. If the check fails, exit, modify the CAE mesh model according to the prompts, and rerun the load loading program until the load is loaded successfully. Step 4: Create the analysis steps required for the stress calculation of the vehicle CAE transient fatigue analysis based on the cards and load collectors; Step 5: Export the vehicle CAE transient fatigue analysis stress calculation file to obtain the modal stress op2 file and the total modal coordinate pch master file; Step 6: Use the transient fatigue analysis loader to split the modal coordinate pch main file into modal coordinate pch sub-files of multiple independent working conditions.

2. The vehicle multi-operating condition CAE transient fatigue analysis loading method according to claim 1 is characterized in that: In step 1, the vehicle multi-condition CAE transient fatigue analysis loader is used to parse the condition load bdf file in TABLED1 format, and then complete the load loading, analysis type setting, result output setting, analysis step creation, and modal coordinate pch main file splitting in the pre-processing software HyperMesh.

3. The vehicle multi-operating condition CAE transient fatigue analysis loading method according to claim 2 is characterized by: In step 2, the CAE basic grid model includes the grid model of the entire vehicle structure and the connection relationship; the CAE basic grid model needs to be weighted as required to meet the calculation requirements; the number of the created attachment point must be consistent with the load node number in the working condition load bdf file in step 1.

4. The vehicle multi-operating condition CAE transient fatigue analysis loading method according to claim 3 is characterized by: In step 4, the analysis step Load Steps includes the modal SOL112 modal analysis step and each operating condition analysis step. The name of each operating condition analysis step is consistent with the name of the operating condition load file selected in step 3, which is convenient for distinguishing and identifying the operating conditions. The program will determine whether the input load is multiple operating conditions. If it is not multiple operating conditions, the load loading process is completed. If it is multiple operating conditions, analysis steps for other operating conditions are created until the creation of all operating condition analysis steps Load Steps is completed.

5. The vehicle multi-operating condition CAE transient fatigue analysis loading method according to claim 4 is characterized in that: In step 5, a calculation file containing all loads and analysis steps is exported, and the SOL112 solver of the finite element software Nastran is used for calculation to obtain a modal stress op2 file and a modal coordinate pch master file containing all working conditions.

6. The vehicle multi-operating condition CAE transient fatigue analysis loading method according to claim 4 is characterized by: In the step 6, the transient fatigue analysis loader is used to split the modal coordinate pch main file of step 5 into modal coordinate pch sub-files of multiple independent working conditions for subsequent fatigue calculations.