Simulation analysis method for strength durability of welded touring car trailer system

The durability performance of the welded RV trailer system is simulated through simulation analysis methods, solving the problems of high costs and frequent tests in the existing technology, achieving durability optimization and design improvement of the trailer system, and improving the test pass rate and safety.

CN118965871APending Publication Date: 2024-11-15CHINA FAW CO LTD
View PDF 0 Cites 1 Cited by

Patent Information

Application Number
CN202410987155.2
Authority / Receiving Office
CN · China
Patent Type
Applications(China)
Current Assignee / Owner
Filing Date
2024-07-23
Publication Date
2024-11-15

AI Technical Summary

Technical Problem

The prior art has high cost and frequent test problems in the simulation analysis of durability performance of welded RV trailer systems, and it is difficult to accurately identify the risk of trailer hook bolt slippage, affecting design optimization and test pass rate.

Method used

A simulation analysis method is adopted, including geometric model processing, finite element model establishment, weld definition, material attribute setting, working condition calculation, bolt slip judgment and result evaluation, and the stress field and durability of the trailer system are simulated by using ABAQUS and FEMFAT software. Performance, evaluate the durability of the trailer system through bolt slip and damage value, and guide design optimization.

Benefits of technology

This method can accurately identify the durability problems of the trailer system in the early stage of design, reduce the number of tests, shorten the R&D cycle, improve the test pass rate, reduce R&D costs, and ensure the safety and durability of the trailer system.

✦ Generated by Eureka AI based on patent content.

Smart Images

  • Figure CN118965871A_ABST
    Figure CN118965871A_ABST
Patent Text Reader

Abstract

The invention discloses a welded touring car trailer system strength endurance quality simulation analysis method, which comprises the following steps that: geometric model input conditions should include a geometric model of a welding seam, and region division is carried out on the model; establishing a finite element model according to the actual matching relationship of the tow hook, the rear cross beam, the tow hook bracket, the vehicle body and the bolt; defining a welding seam; defining material attributes; defining a trailer hook durability simulation analysis working condition, determining the size and direction of a load, and establishing boundary conditions according to requirements; applying a bolt pre-tightening force, defining a friction coefficient, and defining a result required to be output by bolt slippage simulation; the stress field of the trailer system is solved through ABAQUS software; a stress result is imported into FEMFAT software for durability analysis; and evaluating the calculation result. According to the method, the durability working condition result of the welded touring car trailer system can be accurately calculated at the initial stage of design, and whether the trailer hook bolt has the slippage risk in the using process or not is checked through local simulation of the bolt, so that the design of the trailer system is guided, the subsequent test passing rate is increased, the research and development period is shortened, and the research and development cost is saved.
Need to check novelty before this filing date? Find Prior Art

Description

Technical Field

[0001] The invention belongs to the technical field of structural strength and durability simulation analysis, and in particular relates to a strength and durability simulation analysis method for a welded RV trailer system. Background Art

[0002] With the continuous development of society, the per capita consumption capacity is also constantly improving. Cars have become the main means of transportation for people's daily travel, and personalized needs are becoming more and more obvious. Due to the comfort and convenience of RVs, RV travel has become a travel method for more and more families, especially in European and American countries. In China, the scale of the RV market is also increasing year by year. The trailer RV is connected to the tractor in front through the trailer hook assembly. The tractor drives the trailer RV through the trailer bar. Therefore, the trailer hook and crossbeam are the main force transmission components, and their durability is an important safety indicator of the trailer hook assembly. Once the trailer hook breaks during use, it will not only affect the mood of the traveler, causing time and economic losses, but also endanger personal safety.

[0003] The trailer device of a motorhome is mainly composed of a trailer hook, a rear crossbeam, a connecting bracket and connecting bolts. There are clear test requirements for the trailer system. The vehicle body and trailer system are required for the test, and the test cost is high. Once the test fails, the structure needs to be optimized and tested again until it passes. Therefore, in the process of vehicle development, it is extremely important to evaluate the performance and optimize the design of the trailer system through simulation analysis, so that the trailer system can ensure that it will not break under the specified number of bench durability cycles. Summary of the invention

[0004] In order to solve the above-mentioned problems existing in the prior art, the present invention provides a simulation analysis method for the strength and durability performance of a welded RV trailer system, which can accurately calculate the durability working condition results of the welded RV trailer system in the early stage of design, and through local simulation of the bolts, check whether there is a risk of slippage of the trailer hook bolts during use, thereby guiding the design of the trailer system, improving the pass rate of subsequent tests, shortening the R&D cycle, and saving R&D costs.

[0005] The objective of the present invention is achieved through the following technical solutions:

[0006] A method for simulating and analyzing the strength and durability performance of a welded RV trailer system comprises the following steps:

[0007] Step 1: Geometric model processing: The geometric model input conditions should include the geometric model of the weld and divide the model into regions;

[0008] Step 2: Establish a finite element model based on the actual matching relationship between the trailer hook, rear cross beam, trailer hook bracket, vehicle body and bolts;

[0009] Step 3: Define the weld;

[0010] Step 4: Define material properties;

[0011] Step 5. Calculation conditions: define the trailer hook durability simulation analysis conditions, determine the size and direction of the load, and establish boundary conditions as required;

[0012] Step 6: Bolt slip judgment: Apply bolt preload, define friction coefficient, and define the output results of bolt slip simulation;

[0013] Step 7: Calculation and solution, post-processing: Use ABAQUS software to solve the stress field of the trailer system; import the stress results into FEMFAT software for durability performance analysis;

[0014] Step 8. Evaluate the calculation results to determine whether the durability of the trailer hook meets the requirements and whether there is a risk of slippage. If it does not meet the requirements, perform optimization design iterations.

[0015] Furthermore, in the step 1, the model is divided into regions: a dividing line is made 5 mm outward from the outer boundary of the weld, and a dividing line is made 1 mm inward from the inner boundary of the weld.

[0016] Furthermore, in the step 2, the trailer hook, trailer hook bracket, rear cross beam, vehicle body connection bracket and weld seam models are all modeled using second-order tetrahedrons, with a unit type of C3D10M; the connecting bolts are modeled using first-order hexahedrons, with a unit type of C3D8I; the vehicle body is modeled using shell elements, with a unit type of S3 or S4;

[0017] The mesh size requirement for the trailer hook and trailer hook bracket is 2-3mm, the mesh size requirement for the rear cross beam and the body connection bracket is 4-5mm, and the mesh size requirement for the body model is 5-8mm; the weld model requires fine drawing, and the mesh size requirement is 1mm.

[0018] Furthermore, in the step 2, in the 1 mm area cut inward from the inner boundary of the weld in the step 1, a common node connection is established between the trailer hook bracket and the rear cross beam to simulate the welding penetration; the bolts and the nodes of the matching surfaces of the trailer hook bracket correspond one to one.

[0019] Furthermore, in the step 2, the loading point is the center of the trailer ball, and the loading point is connected to the trailer hook through the RBE3 unit; the trailer hook is connected to the trailer hook bracket through bolts; the trailer hook bracket, the rear cross beam, and the body bracket are welded; the body bracket is connected to the body through the RBE2 unit.

[0020] Furthermore, in step 3, a node set (NODESET) is established for each weld node, and the node set naming requirements are as follows:

[0021] FemfatSolidWeld_0001_root1_corner-weld_7P0

[0022] Among them, FemfatSolidWeld is a fixed character; 0001 is the number, and different welds are numbered in sequence; root1 represents the weld root, 1 represents the number, if there are two weld roots, they are numbered in sequence, if it is a weld toe, it is represented by toe; corner-weld represents the weld type; 7P0 represents the weld thickness, P represents the decimal point, and the unit is mm.

[0023] Furthermore, in step 5, the loading point is the center of the trailer ball, and the load size is determined as follows:

[0024] F=0.6*[G1*G2 / (G1+G2)]*g (1)

[0025] In the formula, F is the load of the trailer system, G1 is the mass of the front vehicle, G2 is the mass of the towed vehicle, and g is the acceleration of gravity;

[0026] The loading direction forms an angle of 15° between the xz plane of the vehicle and the horizontal line where the loading point is located;

[0027] The loading is divided into two load steps, the tensile load is one step, the compressive load is one step, and one tension and one compression is one cycle.

[0028] Furthermore, in step six, a preload is applied to the bolt, and the bolt preload is calculated according to formula (2), and the action direction of the bolt preload is along the axial direction of the bolt:

[0029] F=T / (k*D) (2)

[0030] In the formula, F is the bolt preload, T is the bolt tightening torque, k is the bolt tightening torque coefficient, and D is the bolt diameter;

[0031] Set the friction coefficient parameters according to the actual friction coefficient of the material;

[0032] To check the bolt slip, the contact surface cslip result needs to be output;

[0033] The bolt slip check condition is divided into two load steps. The first step is to apply the bolt preload, and the second step is to apply the external load.

[0034] Furthermore, in step seven, the bolt slip check is performed by post-processing the results through ABAQUS software, and the cslip1 and cslip2 results on the bolt-related contact surfaces are read;

[0035] The slip of the bolt is calculated by the following formula:

[0036]

[0037] Where C1 w is the cslip1 result corresponding to the external load step in step 6, C1 y is the result of cslip1 corresponding to the preload step in step 6, C2 w is the cslip2 result corresponding to the external load step in step 6, C2 y The cslip2 result corresponding to the external load step in step 6;

[0038] The stress results were imported into FEMFAT software for durability performance analysis, and the durability results were post-processed using HYPERVIEW software to read the damage value A of the trailer system.

[0039] Furthermore, in the step eight, the bolt slippage is evaluated according to the bolt slippage result. If S<0.1, it is considered that the bolt has no slippage risk. Otherwise, it is considered that the bolt has slippage risk and needs to be optimized.

[0040] The durability performance is evaluated according to the damage value of the trailer system. If A<1, it is considered that the durability performance of the trailer system meets the requirements. Otherwise, it is considered that there is a risk of cracking and the design needs to be optimized.

[0041] The present invention has the following beneficial effects:

[0042] The present invention provides a strength and durability performance simulation analysis method for a welded RV trailer system, which takes into account welding durability issues and the influence of penetration on welding, checks the slippage problem of connecting bolts, and can accurately simulate bench test conditions. In the early stages of design, the strength and durability issues of the trailer system can be identified through simulation means, and the structure can be continuously optimized to guide structural design. This method is suitable for rapid iterative design in the early stages and can shorten the research and development cycle. BRIEF DESCRIPTION OF THE DRAWINGS

[0043] In order to more clearly illustrate the technical solutions in the embodiments of the present invention, the following briefly introduces the drawings used in the description of the embodiments of the present invention. Obviously, the drawings described below are only some embodiments of the present invention. For ordinary technicians in this field, other drawings can be obtained based on the contents of the embodiments of the present invention and these drawings without paying any creative work.

[0044] Figure 1 A flow chart of a method for simulating and analyzing the strength and durability of a welded RV trailer system according to an embodiment of the present invention;

[0045] Figure 2 It is a schematic diagram of the trailer system structure;

[0046] Figure 3 Schematic diagram of local division requirements for welds;

[0047] Figure 4 It is a schematic diagram of the trailer system simulation model;

[0048] Figure 5 Loading direction diagram for trailer system. DETAILED DESCRIPTION

[0049] The present invention will be further described in detail below in conjunction with the accompanying drawings and embodiments. It is to be understood that the specific embodiments described herein are only used to explain the present invention, rather than to limit the present invention. It should also be noted that, for ease of description, only parts related to the present invention, rather than all structures, are shown in the accompanying drawings.

[0050] Example

[0051] like Figure 1 As shown, this embodiment is a simulation analysis method for strength and durability performance of a welded RV trailer system, comprising the following steps:

[0052] Step 1: Geometric model processing: The geometric model input conditions should include the geometric model of the weld, and the model needs to be divided into regions during the geometric processing process.

[0053] The welded RV trailer system includes a trailer hook, a trailer hook bracket, a rear crossbeam, a body connection bracket and bolts, such as Figure 2 As shown, the geometric model input conditions should include the geometric model of the weld, and the shape and length of the weld should be consistent with the actual vehicle situation as much as possible;

[0054] Since the weld mesh is required to be relatively fine, the model needs to be divided into regions during the geometric processing process. In particular, the mesh around the weld is required to be relatively regular. Geometric processing in advance facilitates subsequent mesh division. A dividing line is made 5 mm outward from the outer boundary of the weld (weld toe), and a dividing line is made 1 mm inward from the inner boundary of the weld (weld root), such as Figure 3 As shown; all welding positions must be processed according to the above requirements.

[0055] Step 2: Establish a finite element model: Establish a finite element model based on the actual matching relationship between the trailer hook, rear cross beam, trailer hook bracket, vehicle body and bolts.

[0056] Since the simulation analysis of solid welds requires the unit type to be a second-order tetrahedron, the trailer hook, trailer hook bracket, rear cross beam, body connection bracket and weld models all use second-order tetrahedrons with a unit type of C3D10M; the connecting bolts use first-order hexahedrons with a unit type of C3D8I; the body is modeled using shell elements with a unit type of S3 or S4.

[0057] The mesh size of the trailer hook and trailer hook bracket is required to be 2-3mm, the mesh size of the rear cross beam and the body connection bracket is required to be 4-5mm, and the mesh size of the body model is required to be 5-8mm; the weld model requires fine drawing, and the mesh size is required to be 1mm. The weld and trailer hook bracket interface 1, the weld and rear cross beam interface 2 are both connected by common nodes, and the interface mesh requires at least 4 layers; the trailer hook bracket and rear cross beam interface 3 have no relationship; the positions of interfaces 1, 2, and 3 are as follows Figure 3 As shown. In the 1mm area cut inward from the inner boundary of the weld in step 1, the trailer hook bracket and the rear cross beam are required to establish a common node connection to simulate the welding penetration and improve the simulation accuracy. In order to check the risk of bolt slippage and improve the accuracy of simulation analysis, the nodes of the bolt and the trailer hook bracket mating surface are required to correspond one by one. The loading point is the center of the trailer ball, and the loading point is connected to the trailer hook through the RBE3 unit; the trailer hook is connected to the trailer hook bracket through bolts; the trailer hook bracket, the rear cross beam, and the body bracket are welded; the body bracket is connected to the body through the RBE2 unit.

[0058] In this embodiment, the 5mm area cut in step 1 is cut into 1mm area, 1mm area, 1mm area and 2mm area respectively near the outer boundary of the weld. The first two 1mm areas are recommended to have a grid size of 1mm, the third 1mm area is recommended to have a grid size of 2mm, and the outermost 2mm area is recommended to have a grid size of 4mm, to ensure a uniform transition of the grid and improve the calculation accuracy. The 5mm area cut in step 1 is cut into 1mm area, 1mm area, 1mm area and 2mm area respectively near the outer boundary of the weld. The first two 1mm areas are recommended to have a grid size of 1mm, the third 1mm area is recommended to have a grid size of 2mm, and the outermost 2mm area is recommended to have a grid size of 4mm, to ensure a uniform transition of the grid and improve the calculation accuracy.

[0059] Step 3: Define the weld:

[0060] Using FEMFAT to perform durability simulation on solid welds requires defining a weld set. When modeling, a node set (NODESET) is required for each weld node. The node set naming requirements are as follows:

[0061] FemfatSolidWeld_0001_root1_corner-weld_7P0

[0062] Among them, FemfatSolidWeld is a fixed character; 0001 is the number, and different welds are numbered in sequence; root1 represents the weld root, 1 represents the number, if there are two weld roots, they are numbered in sequence, if it is a weld toe, it is represented by toe; corner-weld represents the weld type; 7P0 represents the weld thickness, P represents the decimal point, and the unit is mm.

[0063] Step 4. Define material properties: Define the material properties of each component, including material elastic modulus and Poisson's ratio.

[0064] Step 5. Calculate the working conditions: define the trailer hook durability simulation analysis working conditions, determine the size and direction of the load, and establish boundary conditions as required.

[0065] The loading point is the center of the trailer ball, and the load size is determined as follows:

[0066] F=0.6*[G1*G2 / (G1+G2)]*g (1)

[0067] Where F is the load on the trailer system, G1 is the mass of the front vehicle, G2 is the mass of the towed vehicle, and g is the acceleration of gravity.

[0068] Loading direction Figure 5 As shown, the angle between the center of the ball and the horizontal line where the loading point is located in the xz plane of the vehicle is 15°. In this embodiment, the center of the ball is below the center line of the beam, and the loading is carried out in the direction marked below the figure. If the center of the ball is above the center line of the beam, the loading direction is loaded in the direction marked above the figure. If the center of the ball is at the same height as the center line of the beam, it is recommended to analyze both directions.

[0069] The loading is divided into two load steps, the tensile load is one step, the compressive load is one step, one tension and one compression is one cycle, and the number of durability simulation analysis cycles is 2 million times.

[0070] Constrain the body part's 1-6 degrees of freedom.

[0071] Step 6. Bolt slip judgment: Apply bolt preload, define friction coefficient, and define the output results of bolt slip simulation.

[0072] A preload is applied to the bolt, where the bolt preload is obtained by the relationship between the bolt preload and the bolt tightening torque. The bolt preload is calculated according to formula (2), where the action direction of the bolt preload is along the axial direction of the bolt. Formula (2) is as follows:

[0073] F=T / (k*D) (2)

[0074] In the formula, F is the bolt preload, T is the bolt tightening torque, k is the bolt tightening torque coefficient, D is the bolt diameter, F is the calculated amount, T is the mass, and k is 0.15.

[0075] The bolt slip is usually checked by taking the minimum value within the given tightening torque range for calculation. The friction coefficient parameter is set according to the actual friction coefficient of the material.

[0076] To check the bolt slip, it is necessary to output the contact surface cslip result. The statement is as follows:

[0077] *CONTACT OUTPUT

[0078] CSLIP.

[0079] The bolt slip check condition is divided into two load steps. The first step is to apply the bolt preload, and the second step is to apply the external load.

[0080] Step 7: Calculation and post-processing: Use ABAQUS software to solve the stress field of the trailer system; import the stress results into FEMFAT software for durability performance analysis.

[0081] The bolt slip check is mainly carried out by post-processing the results through ABAQUS software, reading the cslip1 and cslip2 results on the relevant contact surfaces of the bolt.

[0082] The slip of the bolt is calculated by the following formula:

[0083]

[0084] Where C1 w is the cslip1 result corresponding to the external load step in step 6, C1 y is the result of cslip1 corresponding to the preload step in step 6, C2 w is the cslip2 result corresponding to the external load step in step 6, C2 y This is the cslip2 result corresponding to the external load step in step 6.

[0085] The stress results were imported into FEMFAT software for durability performance analysis, and the durability results were post-processed using HYPERVIEW software to read the damage value A of the trailer system.

[0086] Step 8. Result evaluation and design guidance: Evaluate the calculation results to determine whether the durability of the trailer hook meets the requirements and whether there is a risk of slippage. If it does not meet the requirements, perform optimization design iterations.

[0087] The bolt slippage condition is evaluated according to the bolt slippage result. If S<0.1, it is considered that there is no slippage risk for the bolt. Otherwise, it is considered that there is a slippage risk for the bolt and the design needs to be optimized.

[0088] The durability performance is evaluated according to the damage value of the trailer system. If A<1, it is considered that the durability performance of the trailer system meets the requirements. Otherwise, it is considered that there is a risk of cracking and the design needs to be optimized.

[0089] Although embodiments of the present invention have been shown and described, it will be appreciated by those skilled in the art that various changes, modifications, substitutions and variations may be made to the embodiments without departing from the principles and spirit of the present invention, and that the scope of the present invention is defined by the appended claims and their equivalents.

Claims

1. A simulation analysis method for strength and durability performance of a welded RV trailer system, characterized in that: The following steps are involved: Step 1: Geometric model processing: The geometric model input conditions should include the geometric model of the weld and divide the model into regions; Step 2: Establish a finite element model based on the actual matching relationship between the trailer hook, rear cross beam, trailer hook bracket, vehicle body and bolts; Step 3: Define the weld; Step 4: Define material properties; Step 5. Calculation conditions: define the trailer hook durability simulation analysis conditions, determine the size and direction of the load, and establish boundary conditions as required; Step 6: Bolt slip judgment: Apply bolt preload, define friction coefficient, and define the output results of bolt slip simulation; Step 7: Calculation and solution, post-processing: Use ABAQUS software to solve the stress field of the trailer system; Import stress results into FEMFAT software for durability performance analysis; Step 8. Evaluate the calculation results to determine whether the durability of the trailer hook meets the requirements and whether there is a risk of slippage. If it does not meet the requirements, perform optimization design iterations.

2. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 1, characterized in that: In the step 1, the model is divided into regions: a dividing line is made 5 mm outward from the outer boundary of the weld, and a dividing line is made 1 mm inward from the inner boundary of the weld.

3. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 2, characterized in that: In the step 2, the trailer hook, trailer hook bracket, rear cross beam, vehicle body connection bracket and weld seam models are all modeled using second-order tetrahedrons, with a unit type of C3D10M; the connecting bolts are modeled using first-order hexahedrons, with a unit type of C3D8I; the vehicle body is modeled using shell elements, with a unit type of S3 or S4; The mesh size requirement for the trailer hook and trailer hook bracket is 2-3mm, the mesh size requirement for the rear cross beam and the body connection bracket is 4-5mm, and the mesh size requirement for the body model is 5-8mm; the weld model requires fine drawing, and the mesh size requirement is 1mm.

4. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 2, characterized in that: In the step 2, in the 1mm area cut inward from the inner boundary of the weld in the step 1, the trailer hook bracket and the rear cross beam establish a common node connection to simulate the welding penetration; the bolts and the trailer hook bracket mating surface nodes correspond one to one.

5. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 2, characterized in that: In the step 2, the loading point is the center of the trailer ball, and the loading point is connected to the trailer hook through the RBE3 unit; the trailer hook is connected to the trailer hook bracket through bolts; the trailer hook bracket, the rear cross beam, and the body bracket are welded; the body bracket is connected to the body through the RBE2 unit.

6. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 2, characterized in that: In step 3, a node set (NODESET) is established for each weld node. The node set naming requirements are as follows: FemfatSolidWeld_0001_root1_corner-weld_7P0 Among them, FemfatSolidWeld is a fixed character; 0001 is the number, and different welds are numbered in sequence; root1 represents the weld root, 1 represents the number, if there are two weld roots, they are numbered in sequence, if it is a weld toe, it is represented by toe; corner-weld represents the weld type; 7P0 represents the weld thickness, P represents the decimal point, and the unit is mm.

7. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 2, characterized in that: In step 5, the loading point is the center of the trailer ball, and the load size is determined as follows: F=0.6*[G1*G2 / (G1+G2)]*g (1) In the formula, F is the load of the trailer system, G1 is the mass of the front vehicle, G2 is the mass of the towed vehicle, and g is the acceleration of gravity; The loading direction forms an angle of 15° between the xz plane of the vehicle and the horizontal line where the loading point is located; The loading is divided into two load steps, the tensile load is one step, the compressive load is one step, and one tension and one compression is one cycle.

8. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 2, characterized in that: In step 6, a preload is applied to the bolt, and the bolt preload is calculated according to formula (2). The bolt preload is applied in the axial direction of the bolt: F=T / (k*D) (2) In the formula, F is the bolt preload, T is the bolt tightening torque, k is the bolt tightening torque coefficient, and D is the bolt diameter; Set the friction coefficient parameters according to the actual friction coefficient of the material; To check the bolt slip, the contact surface cslip result needs to be output; The bolt slip check condition is divided into two load steps. The first step is to apply the bolt preload, and the second step is to apply the external load.

9. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 8, characterized in that: In step 7, the bolt slip check is performed by post-processing the results through ABAQUS software, and the cslip1 and cslip2 results on the relevant contact surfaces of the bolts are read; The slip of the bolt is calculated by the following formula: Where C1 w is the cslip1 result corresponding to the external load step in step 6, C1 y is the result of cslip1 corresponding to the preload step in step 6, C2 w is the cslip2 result corresponding to the external load step in step 6, C2 y The cslip2 result corresponding to the external load step in step 6; The stress results were imported into FEMFAT software for durability performance analysis, and the durability results were post-processed using HYPERVIEW software to read the damage value A of the trailer system.

10. A method for simulating and analyzing the strength and durability of a welded RV trailer system as claimed in claim 9, characterized in that: In the step eight, the bolt slippage is evaluated according to the bolt slippage result. If S<0.1, it is considered that the bolt has no slippage risk. Otherwise, it is considered that the bolt has slippage risk and needs to be optimized. The durability performance is evaluated according to the damage value of the trailer system. If A<1, it is considered that the durability performance of the trailer system meets the requirements. Otherwise, it is considered that there is a risk of cracking and the design needs to be optimized.

Citation Information

Cited By

  • Trailer axle welding positioning data processing system and method based on big data analysis

    CN119740311A