A rapid analysis and evaluation method for the strength condition of a lightweight steering knuckle
By using a rapid strength analysis and evaluation method for lightweight steering knuckles, the system automates and performs batch calculations for multi-condition simulation analysis of steering knuckles, solving the time-consuming and labor-intensive problems of existing technologies and improving analysis efficiency and accuracy.
Patent Information
- Application Number
- CN202111177977.7
- Authority / Receiving Office
- CN · China
- Patent Type
- Patents(China)
- Current Assignee / Owner
- Filing Date
- 2021-10-09
- Publication Date
- 2024-11-19
- Estimated Expiration
- 2041-10-09
AI Technical Summary
Existing technologies require calculating each working condition individually in steering knuckle strength analysis, which is time-consuming and labor-intensive. Furthermore, after modifications to the physical digital model structure, repeated simulation analysis is necessary, wasting time.
A rapid strength analysis and evaluation method for lightweight steering knuckles is adopted. Through simulation model preprocessing, mesh generation, material property assignment, and hard point setting, batch processing files are generated to achieve automated multi-condition simulation analysis and batch calculation.
It greatly saves analysis time, improves development efficiency, simplifies the analysis process, avoids repetitive work, and ensures the accuracy and consistency of calculation results.
Smart Images

Figure CN113919199B_ABST
Abstract
Description
Technical Field
[0001] The invention relates to the field of CAE analysis, and in particular to a method for quickly analyzing and evaluating the strength working conditions of a lightweight steering knuckle. Background Art
[0002] The steering knuckle is one of the safety parts of the automobile suspension system. It can make the car run stably and transmit the driving direction sensitively. The function of the steering knuckle is to bear the front and rear loads of the car, support and drive the wheel kingpin to rotate and turn the car. When the car is in motion, it is subjected to variable impact loads, so it is required to have high safety. Under the action of these loads, the strength of the steering knuckle plays a very important role. Its failure will cause the car to lose its ability to turn flexibly, causing unpredictable loss of life and property. In order to meet the demand for lightweight, the steering knuckle needs to be redesigned; in order to determine whether the strength of the redesigned steering knuckle meets the design requirements, it is necessary to perform a strength analysis.
[0003] The strength analysis of a steering knuckle generally has multiple strength conditions. The traditional simulation analysis method requires calculation of each condition one by one. After analyzing one condition, the analysis of the next condition needs to be processed. This requires staring at the computer all the time, which takes up a lot of personal time and computer time. In addition, to design a steering knuckle with qualified characteristics, one version of the physical digital model structure is usually not enough. It needs to be modified and optimized many times, and sometimes it is necessary to modify more than a dozen versions of the physical digital model structure or even more. Due to the change of the physical digital model structure, it is necessary to re-perform the simulation analysis of the strength condition, and most of the work needs to be started from scratch, especially since the steering knuckle generally has more conditions. This will waste a lot of precious time on repetitive work due to data modification.
[0004] Therefore, a rapid analysis and evaluation method for strength conditions is needed to save analysis time and speed up development efficiency. Summary of the invention
[0005] The technical problem to be solved by the present invention is to provide a rapid analysis and evaluation method for strength conditions that saves time and improves development efficiency in view of the current status of the prior art.
[0006] The technical solution adopted by the present invention to solve the above technical problem is that a method for rapid analysis and evaluation of the strength working condition of a lightweight steering knuckle comprises the following steps:
[0007] S0, let d = 1;
[0008] S1. Design the structure of the dth version of the steering knuckle solid digital model according to the lightweight weight reduction target;
[0009] S2, simulation model pre-processing: importing the steering knuckle entity digital model into finite element pre-processing software, performing simulation model pre-processing on the dth version of the steering knuckle entity digital model structure, including creating a hard point set, performing mesh division, and exporting a pre-processing information file;
[0010] S3, assigning material properties and setting hard point related parameters: importing the pre-processing information file into the finite element solution software, assigning material properties, and setting hard point related parameters;
[0011] S4, determine whether d≤1 is established, if yes, go to step S5; if no, go to step X5;
[0012] S5. Setting parameters related to the first strength condition;
[0013] S6, obtaining the first version of the grid information file and the first working condition information file: outputting the first version of the simulation analysis file, and splitting the first version of the simulation analysis file into the first version of the grid information file and the first working condition information file, wherein the first version of the grid information file includes the simulation model pre-processing information of step S2, the material properties and hard point related parameter information of step S3, and the first working condition information file includes the first strength working condition related parameter information of step S5;
[0014] S7, obtaining n working condition information files corresponding to n strength working conditions: based on the first working condition information file, modifying the working condition information in the first working condition information file according to the second strength working condition, obtaining the second working condition information file, repeating this step until the nth working condition information file of the nth strength working condition is obtained, thereby obtaining n working condition information files corresponding to the n strength working conditions;
[0015] This step only requires modifying the load value in the first working condition information file to obtain the corresponding working condition information files under other strength working conditions. There is no need to repeat the above steps, which simplifies the analysis process and improves analysis efficiency.
[0016] S8. Generate a batch file using a batch file generation module: the batch file generation module can automatically extract the data of the first version of the grid information file and the data of the kth working condition information file to form a complete kth strength working condition simulation analysis data, wherein k is sequentially taken as 1, 2, 3, ... until n, to obtain a batch file containing n strength working condition simulation analysis data, and after completing this step, go to step S9;
[0017] In this step, since the mesh information of each strength condition has not changed, the first version of the mesh information file can be used, thereby saving the time for obtaining the corresponding mesh information file.
[0018] X5. Export the dth version of the mesh information file: the dth version of the mesh information file includes the simulation model pre-processing information of step S2, the material properties and hard point related parameter information of step S3;
[0019] X6. Generate a batch file using a batch file generation module: the batch file generation module can automatically extract the data of the d-th grid information file obtained in step X5 and the data of the k-th working condition information file obtained in steps S6-S7, and combine them into complete k-th strength working condition simulation analysis data, wherein k takes values of 1, 2, 3, ... until n, and obtains a batch file containing n strength working condition simulation analysis data; after completing this step, go to step S9;
[0020] The n working condition information files in this step use the data of the n working condition information files obtained in steps S6-S7. Because different versions of the steering knuckle solid digital model structures are analyzed under the same strength conditions, there is no need to obtain the working condition information files again, saving analysis time.
[0021] S9, batch submission calculation: having a batch file calculation module, submitting the batch file to the batch file calculation module, and being able to calculate the stress distribution results of n strength conditions at one time;
[0022] The batch file calculation module can use batch files to call finite element solution software (such as abaqus) for calculation.
[0023] This step only requires submitting the calculation once to get the results of n strength conditions. In this way, while the computer is calculating and analyzing, the engineer can do other work, which will not take up the engineer's time, and there is no need to check the progress of the analysis all the time. Only the computer performs analysis and calculation in the background, which greatly saves time. In the prior art, to get the results of n strength conditions, it is necessary to submit n times, and the engineer needs to wait for the previous calculation to be completed before submitting the calculation of the next condition, which is very time-consuming and labor-intensive.
[0024] S10, evaluate strength performance: if all the n stress distribution results obtained meet the strength condition evaluation index, they are qualified and the process ends; if at least one stress distribution result does not meet the strength condition evaluation index, it is unqualified, so that d=d+1, and return to step S1.
[0025] In order to obtain more accurate stress distribution results, the step S2, simulation model pre-processing includes the step of establishing hidden components A1, specifically: the steering knuckle entity mold has multiple mounting holes, and a ring-shaped hidden component is established for each mounting hole, the hidden component radially extends from the outer edge of the mounting hole, and the thickness of the hidden component is at least 2 times the grid size; and all hidden components are cut apart from the steering knuckle body, and the steering knuckle body and the hidden components are respectively stored in component set 1 and component set 2;
[0026] Correspondingly, there is a step S9.5, correcting the stress distribution results between the step S9, batch submission of calculations and the step S10, evaluation of strength performance: open the stress distribution results of n strength conditions in sequence, and hide the component set 2 to obtain the corresponding corrected n stress distribution results.
[0027] The steering knuckle is provided with multiple mounting holes, and the steering knuckle is connected and assembled with the surrounding parts through the mounting holes. During the simulation analysis and calculation, the surrounding parts are simplified into a hard point, and then the connection between the steering knuckle and the surrounding parts is simulated by establishing a connection between the hard point and the contact surface. During the analysis and calculation, the inner surface of the mounting hole is used as a coupling surface to establish a connection with the hard point, and stress concentration will appear near the coupling surface. Stress concentration will cause the stress near the coupling surface to be very large, which will far exceed the actual stress of the component, resulting in inaccurate analysis and calculation results. Therefore, we generally do not consider the stress near the coupling surface. During post-processing, we generally hide the mesh near the coupling surface.
[0028] In the prior art, it is difficult to keep the number and position of meshes near the coupling surface consistent each time the meshes are manually hidden, which will cause different stress magnitudes here in each working condition. In addition, the workload is repetitive and huge, which not only takes a lot of time to hide the meshes, but also causes errors in the displayed results.
[0029] The step of establishing hidden components cooperates with step S9.5 to quickly and accurately hide all stress concentration meshes at one time through hidden component set 2, thereby avoiding stress result display errors caused by manually hiding meshes.
[0030] Preferably, the specific steps of step S2, simulation model pre-processing, are:
[0031] a. Import finite element pre-processing software: Import the steering knuckle solid model into the finite element pre-processing software (such as Hypermesh);
[0032] b. Create a hard point set: input the point coordinates of each hard point in the finite element pre-processing software in sequence, obtain each hard point, and establish a hard point set, and save each force-bearing hard point in the hard point set;
[0033] c. The steps of establishing hidden components are as mentioned above;
[0034] d. Mesh division: Second-order tetrahedron is generally used for mesh division, and the mesh size is selected to be about 3mm. Finer meshes can be used in key areas, and in order to ensure accuracy, the mesh in the minimum thickness direction must be guaranteed to have more than 2 layers;
[0035] The hidden component must be guaranteed to have two circles of grids.
[0036] Preferably, the specific steps of S3, assigning material properties and setting hard point related parameters are:
[0037] a. Import the pre-processing information file into finite element solution software (such as abaqus) and assign material properties.
[0038] b. Rename the hard points: rename the hard points in the hard point set to C1, ..., Cn in sequence.
[0039] c. Establish association: According to the assembly relationship between each hard point and the corresponding surrounding parts, create the corresponding association of each hard point. The association of the present invention uses a rigid connection relationship. The preferred specific steps are: establish a rigid connection relationship (kinematic) in the solver Abaqus; select the hard point renamed in step 2 as the control point, and select the coupling surface corresponding to the hard point as the surface, and create the association mode of all hard points in this way.
[0040] This step renames the hard points:
[0041] When calculating the strength working condition simulation analysis data, the simulation analysis software first identifies the name of the hard point, and then reads the load values in the six directions of x, y, z, around x, around y, and around z on the hard point.
[0042] Renaming hard points has the following benefits:
[0043] 1. It is convenient to quickly find the hard points that need to be modified in the subsequent steps S6-S7 (obtaining n working condition information corresponding to n strength working conditions). The name of the hard point can be numbers, letters, and their combination. The system defaults the name of the node to be the node number of the node. The node number is generally five or six digits, or even larger, which is not convenient for creating working condition information of other strength working conditions later.
[0044] 2. The load values of the six directions of x, y, z, around x, around y, and around z on each hard point in the preliminary preparation data of simulation analysis are generally stored in the XLSX worksheet, which is arranged in the order of the hard points, so the hard points are also renamed in this order. Different load values can be quickly loaded on the hard points in different directions, which is also convenient for later inspection.
[0045] Preferably, the step S5, setting parameters related to the first strength condition, comprises the following specific steps:
[0046] a. Establish analysis steps: Select implicit nonlinear analysis type. To facilitate convergence, set the initial step to 0.01.
[0047] b. Apply loads and constraints: According to the requirements of the first strength condition, apply load values corresponding to the six directions of x, y, z, around x, around y, and around z to each hard point C1, C2, ..., Cn; and select inertia release constraints. The external loads of the inertia release constraint analysis have a series of translational and rotational acceleration balances. These acceleration groups form a bulk load and are distributed on the entire steering knuckle structure. The vectors of these loads just make the total load acting on the steering knuckle structure 0; this provides a steady-state stress and deformation for the analysis, which is equivalent to the steering knuckle doing free uniform acceleration motion under these loads, making the analysis results more accurate.
[0048] Compared with the prior art, the advantages of the present invention are:
[0049] 1. In steps S6-S7 of the present invention, only the load value in the first working condition information file needs to be modified to obtain the corresponding working condition information files under other strength working conditions, without repeating the setting steps, thus saving analysis time;
[0050] 2. In step S8, since the grid information of each strength condition has not changed, the first version of the grid information file can be used, thereby saving the time of obtaining the corresponding grid information file;
[0051] 3. Step X6: n working condition information files use the data of n working condition information files obtained in step S6-7. Because different versions of steering knuckle entity digital model structures are analyzed under the same strength working condition, there is no need to obtain working condition information files again, thus saving analysis time.
[0052] 4. Steps S8 and X6 generate batch files. The batch file calculation module in step S9 can calculate the stress distribution results of n strength conditions at one time, without the need to calculate one by one, which greatly saves time.
[0053] In summary, the present invention, through the mutual cooperation between various steps, finally transforms each setting process in the strength analysis into obtaining the corresponding grid information file and the working condition information file, and finally integrates the strength working condition simulation analysis data of n working conditions that need to be calculated into the batch file. It only needs to submit the batch file to the batch file calculation module once to calculate the stress distribution results of n strength working conditions at one time, which simplifies the analysis process, saves analysis time, and speeds up the development process of the steering knuckle. BRIEF DESCRIPTION OF THE DRAWINGS
[0054] Figure 1 A flowchart of a rapid analysis and evaluation method according to an embodiment of the present invention;
[0055] Figure 2 It is a schematic structural diagram of a hidden component according to an embodiment of the present invention. DETAILED DESCRIPTION
[0056] The specific implementation of the present invention is further described in detail below in conjunction with the drawings and examples.
[0057] like Figure 1 The flowchart of the rapid analysis and evaluation method of this embodiment is shown. The rapid analysis and evaluation method of the strength working condition of the lightweight steering knuckle comprises the following steps:
[0058] S0, let d = 1
[0059] S1. Design the dth version of the steering knuckle entity digital model structure according to the lightweight weight reduction goal;
[0060] S2. Simulation model pre-processing: Preferably, the simulation model pre-processing includes importing finite element pre-processing software, creating hard point sets, establishing hidden components, meshing, and exporting pre-processing information files. The specific steps are as follows;
[0061] 1. Importing finite element pre-processing software: Import the steering knuckle solid digital model into the finite element pre-processing software. This embodiment uses Hypermesh.
[0062] 2. Create a hard point set: Enter the coordinates of each hard point in the finite element pre-processing software in turn, obtain each hard point, and establish a hard point set, saving each force-bearing hard point in the hard point set.
[0063] 3. Create hidden components: The steering knuckle entity mold has multiple mounting holes. For each mounting hole, create a ring-shaped hidden component A1. The hidden component A1 extends radially from the outer edge of the mounting hole. The thickness of the hidden component A1 is at least twice the grid size. All hidden components A1 are cut apart from the steering knuckle body A2, and the steering knuckle body A2 and hidden components A1 are saved in component set 1 and component set 2 respectively. The structure of hidden component A1 is as follows: Figure 2 As shown;
[0064] 4. Mesh division: Second-order tetrahedron is generally used for mesh division, and the mesh size is selected to be about 3mm. Finer meshes can be used in key areas, and in order to ensure accuracy, the minimum thickness direction mesh must be guaranteed to have more than 2 layers. The hidden part A1 must have two circles of mesh.
[0065] 5. Export pre-processing information file: Export the pre-processing information file including the hard point set, hidden parts, and mesh division information after steps 1-4.
[0066] S3, assigning material properties and setting hard point related parameters: preferably, specifically comprising the following steps:
[0067] 1. Import the pre-processing information file into the finite element solution software, which is abaqus in this embodiment. The material of this embodiment is aluminum alloy, and the corresponding material properties are assigned.
[0068] 2. Rename the hard points: Rename the hard points in the hard point set to C1, ..., Cn in sequence.
[0069] 3. Establish association: According to the assembly relationship between each hard point and the corresponding surrounding parts, create the corresponding association of each hard point. The association of the present invention uses a rigid connection relationship. The preferred specific steps are: establish a rigid connection relationship (kinematic) in the solver Abaqus; select the hard point renamed in step 2 as the control point, and select the coupling surface corresponding to the hard point as the surface, and create the association mode of all hard points in this way.
[0070] S4, determine whether d≤1 is established, if yes, go to step S5; if no, go to step X5;
[0071] S5, setting parameters related to the first strength condition, preferably including the following steps:
[0072] 1. Establish analysis steps: Select implicit nonlinear analysis type. To facilitate convergence, set the initial step to 0.01.
[0073] 2. Apply loads and constraints: According to the requirements of the first strength condition, apply load values corresponding to the six directions of x, y, z, around x, around y, and around z to each hard point C1, C2, ..., Cn; and select inertia release constraints. The external loads of the inertia release constraint analysis have a series of translational and rotational acceleration balances. These acceleration groups form a bulk load and are distributed on the entire steering knuckle structure. The vectors of these loads just make the total load acting on the steering knuckle structure 0; this provides a steady-state stress and deformation for the analysis, which is equivalent to the steering knuckle doing free uniform acceleration motion under these loads, making the analysis results more accurate.
[0074] S6, obtaining the first version of the grid information file and the first working condition information file: outputting the first version of the simulation analysis file, and splitting the first version of the simulation analysis file into the first version of the grid information file and the first working condition information file, the first version of the grid information file including the simulation model pre-processing information of step S2, the material properties and hard point related parameter information of step S3, and the first working condition information file including the first strength working condition related parameter information of step S5;
[0075] S7, obtaining n working condition information files corresponding to n strength working conditions: based on the first working condition information file, according to the second strength working condition, modify the working condition information in the first working condition information file (the working condition information is generally the load values in six directions of x, y, z, around x, around y, around z), obtain the second working condition information file, repeat this step until the nth working condition information file of the nth strength working condition is obtained, thereby obtaining n working condition information files corresponding to the n strength working conditions;
[0076] This step only requires modifying the load value in the first working condition information file to obtain the corresponding working condition information files under other strength working conditions. There is no need to repeat the above steps, which simplifies the analysis process and improves analysis efficiency.
[0077] S8. Use the batch file generation module to generate a batch file: The batch file generation module can automatically extract the data of the first version of the grid information file and the data of the kth working condition information file to form a complete kth strength working condition simulation analysis data. k takes the value of 1, 2, 3... to n in sequence, and a batch file containing n strength working condition simulation analysis data is obtained; after completing this step, go to step S9.
[0078] In this step, since the mesh information of each strength condition has not changed, the first version of the mesh information file can be used, thereby saving the time of obtaining the corresponding mesh information file.
[0079] X5. Export the version d mesh information file, where the version d mesh information file includes the simulation model pre-processing information of step S2, the material properties of step S3, the hard point renaming information of step S4, and the association information of step S5;
[0080] X6. Use the batch file generation module to generate a batch file: The batch file generation module can automatically extract the data of the d-th version of the grid information file obtained in step X5 and the data of the k-th working condition information file obtained in steps S6-S7, and combine them into the complete k-th strength working condition simulation analysis data. k takes the value of 1, 2, 3... to n in sequence, and a batch file containing n strength working condition simulation analysis data is obtained; after completing this step, go to step S9.
[0081] The n working condition information files in this step use the data of the n working condition information files obtained in steps S6-S7. Because different versions of the steering knuckle solid digital model structures are analyzed under the same strength conditions, there is no need to obtain the working condition information files again, saving analysis time.
[0082] S9. Batch submission calculation: With a batch file calculation module, by submitting batch files to the batch file calculation module, the stress distribution results of n strength conditions can be calculated at one time.
[0083] The batch file calculation module can use batch files to call finite element solution software (such as abaqus) for calculation.
[0084] This step only requires submitting the calculation once to get the results of n strength conditions. In this way, while the computer is calculating and analyzing, the engineer can do other work, which will not take up the engineer's time, and there is no need to check the progress of the analysis all the time. Only the computer performs analysis and calculation in the background, which greatly saves time. In the prior art, to get the results of n strength conditions, it is necessary to submit n times, and the engineer needs to wait for the previous calculation to be completed before submitting the calculation of the next condition, which is very time-consuming and labor-intensive.
[0085] S9.5. Corrected stress distribution results: Open the stress distribution results of n strength conditions in turn, hide component set 2, and obtain the corresponding corrected n stress distribution results.
[0086] For example, the stress distribution analysis result near the mounting hole of the front steering knuckle is inaccurate. In order to obtain accurate stress distribution results, it needs to be hidden. In the prior art, it is difficult to keep the number and position of the meshes near the coupling surface manually hidden each time, which will cause the stress magnitude here to be different in each working condition. In addition, the workload is repetitive and huge, which not only takes a lot of time to hide the meshes, but also causes errors in the displayed results.
[0087] This step can quickly and accurately hide all stress concentration meshes at once by hiding component set 2, thereby avoiding stress result display errors caused by manually hiding meshes.
[0088] S10, evaluate strength performance: if all the n stress distribution results obtained meet the strength condition evaluation index, they are qualified and the process ends; if at least one stress distribution result does not meet the strength condition evaluation index, it is unqualified, so that d=d+1, and return to step S1.
[0089] The technical means disclosed in the scheme of the present invention are not limited to the technical means disclosed in the above-mentioned implementation mode, but also include technical schemes composed of any combination of the above-mentioned technical features. It should be pointed out that for ordinary technicians in this technical field, several improvements and modifications can be made without departing from the principle of the present invention, and these improvements and modifications are also regarded as the protection scope of the present invention.
Claims
1. A method for rapid analysis and evaluation of the strength working condition of a lightweight steering knuckle, characterized in that The following steps are involved: S0, let d = 1; S1. Design the structure of the dth version of the steering knuckle solid digital model according to the lightweight weight reduction target; S2, simulation model pre-processing: importing the steering knuckle entity digital model into finite element pre-processing software, performing simulation model pre-processing on the dth version of the steering knuckle entity digital model structure, including creating a hard point set, performing mesh division, and exporting a pre-processing information file; S3, assigning material properties and setting hard point related parameters: importing the pre-processing information file into the finite element solution software, assigning material properties, and setting hard point related parameters; S4, determine whether d≤1 is established, if yes, go to step S5; if no, go to step X5; S5. Setting parameters related to the first strength condition; S6, obtaining the first version of the grid information file and the first working condition information file: outputting the first version of the simulation analysis file, and splitting the first version of the simulation analysis file into the first version of the grid information file and the first working condition information file, wherein the first version of the grid information file includes the simulation model pre-processing information of step S2, the material properties and hard point related parameter information of step S3, and the first working condition information file includes the first strength working condition related parameter information of step S5; S7, obtaining n working condition information files corresponding to n strength working conditions: based on the first working condition information file, modifying the working condition information in the first working condition information file according to the second strength working condition, obtaining the second working condition information file, repeating this step until the nth working condition information file of the nth strength working condition is obtained, thereby obtaining n working condition information files corresponding to the n strength working conditions; S8. Generate a batch file using a batch file generation module: the batch file generation module can automatically extract the data of the first version of the grid information file, and combine it with the data of the kth working condition information file to form a complete kth strength working condition simulation analysis data, wherein k takes values of 1, 2, 3... up to n in sequence, and obtains a batch file containing n strength working condition simulation analysis data. After completing this step, go to step S9; X5. Export the dth version of the grid information file: the dth version of the grid information file includes the simulation model pre-processing information of step S2, the material properties and hard point related parameter information of step S3; X6. Generate a batch file using a batch file generation module: the batch file generation module can automatically extract the data of the dth version of the grid information file obtained in step X5, and combine it with the data of the kth working condition information file obtained in steps S6-S7 to form a complete kth strength working condition simulation analysis data, wherein k takes values of 1, 2, 3... up to n in sequence, and obtains a batch file containing n strength working condition simulation analysis data; After completing this step, go to step S9; S9, batch submission calculation: having a batch file calculation module, submitting the batch file to the batch file calculation module, and being able to calculate the stress distribution results of n strength conditions at one time; S10, evaluate strength performance: if all the n stress distribution results obtained meet the strength condition evaluation index, they are qualified and the process ends; if at least one stress distribution result does not meet the strength condition evaluation index, it is unqualified, so that d=d+1, and return to step S1.
2. The method for rapid analysis and evaluation of strength working conditions of a lightweight steering knuckle according to claim 1 is characterized in that: The step S2, simulation model pre-processing, includes a step of establishing a hidden component, specifically: the steering knuckle entity mold has multiple mounting holes, and a ring-shaped hidden component (A1) is established for each mounting hole, the hidden component (A1) radially extends from the outer edge of the mounting hole, and the thickness of the hidden component (A1) is at least 2 times the grid size; and all the hidden components (A1) are cut apart from the steering knuckle body (A2), and the steering knuckle body (A2) and the hidden components (A1) are respectively saved in component set 1 and component set 2; Correspondingly, there is a step between the step S9, batch submission calculation and the step S10, evaluation of strength performance: S9.5 Correction of stress distribution results: Open the stress distribution results of n strength conditions in turn, and hide the component set 2 to obtain the corresponding corrected n stress distribution results.
3. The method for rapid analysis and evaluation of strength working conditions of a lightweight steering knuckle according to claim 2 is characterized in that: The specific steps of step S2, simulation model pre-processing, are as follows: a. Import finite element pre-processing software: import the steering knuckle solid model into the finite element pre-processing software; b. Create a hard point set: input the point coordinates of each hard point in the finite element pre-processing software in sequence, obtain each hard point, and establish a hard point set, and save each hard point in the hard point set; c. the step of establishing a hidden component; d. Mesh division: A second-order tetrahedron is used for mesh division, and the mesh size is 3 mm. In order to ensure accuracy, the minimum thickness direction mesh must be guaranteed to have more than 2 layers; wherein the hidden component (A1) must be guaranteed to have two circles of mesh.
4. The method for rapid analysis and evaluation of strength working conditions of a lightweight steering knuckle according to claim 3 is characterized in that: The specific steps of S3, assigning material properties and setting hard point related parameters are as follows: a. Import the pre-processing information file into the finite element solution software and assign material properties; b. Rename the hard points: rename the hard points in the hard point set to C1, ..., Cn in sequence; c. Establish association: According to the assembly relationship between each hard point and the corresponding peripheral parts, create the corresponding association of each hard point. The association of the present invention uses a rigid connection relationship.
5. The method for rapid analysis and evaluation of strength working conditions of a lightweight steering knuckle according to claim 4 is characterized in that: The step S5 is to set the parameters related to the first strength condition, and the specific steps are: a. Establish analysis steps: select implicit nonlinear analysis type, and set the initial step to 0.01 for easy convergence; b. Apply loads and constraints: According to the requirements of the first strength condition, apply load values corresponding to the six directions of x, y, z, around x, around y, and around z to each hard point C1, C2, ..., Cn; and select inertia release constraint.
Citation Information
Patent Citations
A method for analyzing fatigue life of steering knuckle
CN109214078A
A processing method for K & C characteristic data of automobile suspension
CN109543253A
Performance evaluation system for automobile chassis structural parts
CN112100732A
Optimization and design method of automobile chassis part
CN112131664A
Automobile body-in-white strength automatic simulation analysis method
CN112699457A
