A simulation analysis method for bonding strength of vehicle central control screen
Through the three-dimensional geometric model and finite element analysis of the central control screen of the vehicle machine, the connection relationship between components is simulated, and the high cost and long-term problems of the structural strength verification of the central control screen of the vehicle machine are solved, and the observation of the adhesive strip process and Analysis improves design efficiency.
Patent Information
- Application Number
- CN202111621753.0
- Authority / Receiving Office
- CN · China
- Patent Type
- Patents(China)
- Current Assignee / Owner
- Filing Date
- 2021-12-28
- Publication Date
- 2024-12-06
- Estimated Expiration
- 2041-12-28
AI Technical Summary
The existing technology of the central control screen structure verification scheme of the CRRC machine has high cost and a long test cycle. It is impossible to observe the adhesive strip process, and it is difficult to analyze the reasons for the debonding.
The three-dimensional geometric model of the central control screen of the vehicle machine is imported and cleaned, a finite element model is established, the contact algorithm is selected to simulate the connection relationship between components, and the maximum equivalent stress cloud diagram and numerical value of the VHB rubber strip are analyzed through numerical simulation, combined with tensile test The results were analyzed.
The numerical simulation method saves test costs, shortens the design cycle, and can simulate the deformation and stress and strain state of the adhesive strip at any time, helping designers quickly analyze and solve the bonding strength problems.
Smart Images

Figure CN114239151B_ABST
Abstract
Description
Technical Field
[0001] The present invention relates to automobile component design simulation technology, and in particular to a vehicle central control screen bonding strength simulation analysis method. Background Art
[0002] During the driving process, especially when encountering some safety accidents, the auto parts will be subject to impact excitation from the car body. Under these impact loads, the auto parts are prone to strength damage and affect their normal operation. The screen and the middle frame of the car computer central control screen are bonded together with VHB adhesive strips. Under impact loads, the adhesive strips are prone to debonding, causing the screen and the middle frame to separate, resulting in appearance damage and even affecting its performance.
[0003] At present, product designers usually use test methods to verify the strength of the central control screen structure of the car. As for the bonding strength between the screen and the middle frame, the test process requires a large number of test prototypes, resulting in high test costs and long test cycles. More importantly, it is impossible to observe the debonding process of the rubber strip during the test. It can only be repeatedly corrected based on the final test results, making it very difficult to analyze the cause of the debonding of the rubber strip. Summary of the invention
[0004] The technical problem to be solved by the present invention is to propose a simulation analysis method for the bonding strength of the vehicle central control screen, so as to solve the problems in the prior art of the strength verification scheme for the vehicle central control screen structure, such as high cost and long test cycle, inability to observe the debonding process of the rubber strip during the test, and being unfavorable for further analysis.
[0005] The technical solution adopted by the present invention to solve the above technical problems is:
[0006] A method for simulating and analyzing the bonding strength of a vehicle central control screen comprises the following steps:
[0007] Import the 3D geometric model of the vehicle central control screen and clean up the model;
[0008] Establish a finite element model of the vehicle central control panel subjected to impact load, and then export the K file;
[0009] Edit the K file and select the contact algorithm to simulate the connection relationship between components;
[0010] Submit the K file for calculation and solution, and obtain the vehicle energy curve after successful solution;
[0011] The rationality of the calculation results is judged according to the vehicle energy curve. If the calculation results are reasonable, the maximum equivalent stress cloud diagram and value of the VHB rubber strip are further obtained, and compared with the tensile test results of the VHB rubber strip substrate to obtain the analysis results.
[0012] As a further optimization, the model cleaning includes:
[0013] Remove small chamfers, small fillets, small holes, imprints and other geometric features, simplify non-focus components with complex external structures into solid bodies with regular shapes, and convert the extracted surfaces of sheet metal parts into shell elements.
[0014] As a further optimization, the establishment of a finite element model of the vehicle central control panel subjected to impact load specifically includes: selecting a material constitutive model to determine material parameters, dividing a mesh model, setting boundary conditions and loads, and setting solution control parameters.
[0015] As a further optimization, when establishing the finite element model of the vehicle central control panel subjected to impact load, the post-compensation method is used to optimize the compensation of the half-sine pulse, the loading curves of acceleration, velocity and displacement are determined by the integration method, and the time-acceleration curve is applied to the vehicle structure.
[0016] As a further optimization, the contact algorithm is selected to simulate the connection relationship between components, specifically including:
[0017] The surface-to-surface contact and single-surface contact algorithms are mainly used to simulate the binding and friction contact between components. At the same time, the node rigid body is used to simulate the connection relationship of the screws, and the special node set CONSTRAINED_EXTRA_NODES is used to simulate the contact between the flexible body and the rigid body.
[0018] As a further optimization, the method also includes: during the calculation and solution process of the K file, if a calculation error is reported, adjustments are made based on the grid model, contact settings, and solution settings until the solution is successful.
[0019] As a further optimization, the rationality of the calculation result is judged, specifically including: judging whether energy is conserved and whether the ratio of hourglass energy to internal energy is less than 10% according to the vehicle energy curve.
[0020] As a further optimization, the method also includes: if the rationality of the calculation result does not meet the requirements, the model is modified again and the calculation is submitted.
[0021] As a further optimization, the method also includes: in the analysis results, if the maximum equivalent stress value is greater than the tensile strength of the substrate, it indicates that the VHB strip is damaged, the bonding ability of the VHB strip is reduced, and there is a risk of debonding.
[0022] The beneficial effects of the present invention are:
[0023] The numerical simulation method is used to study the bonding strength problem between the central control screen and the middle frame of the car computer. Compared with the experimental method, it not only saves the experimental cost and shortens the structural research and development design cycle, but also can simulate the deformation and stress-strain state of the rubber strip at any time, which is convenient for designers to quickly analyze and solve problems. BRIEF DESCRIPTION OF THE DRAWINGS
[0024] Figure 1 is a flow chart of a vehicle central control screen bonding strength simulation analysis method in an embodiment;
[0025] Figure 2 (a), (b), and (c) are the time curves of acceleration, velocity, and displacement under half-sine pulse excitation, respectively;
[0026] Figure 3 This is the energy curve of the vehicle. DETAILED DESCRIPTION
[0027] The present invention aims to propose a simulation analysis method for the bonding strength of the central control screen of a vehicle, so as to solve the problems of high cost and long test cycle in the strength verification scheme of the central control screen structure of a vehicle in the prior art, and the inability to observe the debonding process of the rubber strip during the test, which is not conducive to further analysis. The present invention can analyze the strength problem of the VHB rubber strip between the central control screen of the vehicle and the middle frame under specific impact excitation by means of numerical simulation, provide safe and reliable suggestions for the structural design of the vehicle, greatly save product testing costs, and improve product research and development efficiency.
[0028] Example:
[0029] like Figure 1 As shown, the vehicle central control screen bonding strength simulation analysis method in this embodiment includes the following implementation steps:
[0030] (1) Import the 3D geometric model of the central control screen and clean up the model:
[0031] In this step, the 3D geometric model of the car's central control screen is imported into the SpaceClaim software for model cleaning, including extracting the center surface of metal components such as the host housing and bracket structure, converting them into shell units, cleaning up small chamfers, small fillets, small holes, small faces, imprints and other geometric features in the structure, and simplifying PCB board components with complex shapes and no focus on them into solid bodies with regular shapes.
[0032] (2) Establish a finite element model of the vehicle central control panel subjected to impact load, and then export the K file:
[0033] In this step, the LS_DYNA module of ANSYS Workbench is used to establish a finite element model of the vehicle central control screen subjected to impact loads. First, a suitable constitutive model is selected to describe the mechanical deformation behavior of each component. All flexible body materials use a bilinear elastoplastic constitutive model to determine the material density, elastic modulus, Poisson's ratio, yield strength and tangent modulus. The elastic constitutive model is used for rigid body materials. Then, meshing is performed to divide the entity into tetrahedral and hexahedral meshes, and the shell elements into quadrilateral and triangular meshes. It is also checked whether the mesh quality is greater than 0.7 and whether it meets the mesh quality requirements for display dynamics analysis. Then, boundary conditions and loads are set, gravity acceleration is applied to the entire model, and a time-acceleration curve is applied at the location where the vehicle central control screen bracket is connected to the vehicle body. The curve is shown in Fig. Figure 2 As shown, set the solution calculation time to 0.0716s and turn on the quality scaling option. After completing the above operations, output the calculation K file.
[0034] (3) Edit the K file and select the contact algorithm to simulate the connection relationship between components:
[0035] In this step, the calculation K file is edited using LS_PrePost (finite element pre- and post-processing software), mainly to set the contact relationship between components, where the surface-to-surface contact and single-surface contact algorithms are mainly used to simulate the binding and friction contact between components, and the node rigid body is used to simulate the connection relationship of the screws. The keyword is *CONSTRAINED_NODAL_RIGID_BODY, and for the binding connection between the rigid body and the flexible body, the special node set CONSTRAINED_EXTRA_NODES is used. Considering that the debonding of the adhesive strip is mainly caused by the damage of the adhesive strip substrate, the bonding relationship between the VHB adhesive strip and other components is simulated by the binding contact algorithm. Therefore, the binding contact between the VHB and the middle frame adopts the surface-to-surface contact algorithm, and the bonding relationship between the VHB adhesive strip and the screen is defined as a special node set on the rigid body by selecting a series of points on the VHB adhesive strip.
[0036] (4) Submit the K file for calculation and solution. After successful solution, the vehicle energy curve is obtained:
[0037] In this step, submit the K file for calculation and solution. If the calculation error is reported, make adjustments based on the mesh model, contact settings, solution settings, etc. until the solution is successful and the vehicle energy curve is obtained. The vehicle energy curve is shown in Figure 3 .
[0038] (5) Judge the rationality of the calculation results. If the calculation results are reasonable, compare the maximum equivalent stress cloud diagram and value of the VHB rubber strip with the tensile test results of the VHB rubber strip substrate to obtain the analysis results:
[0039] In this step, the rationality of the calculation results is judged according to the vehicle energy curve, mainly to judge whether the energy is conserved and whether the ratio of hourglass energy to internal energy is less than 10%. If not, it indicates that the calculation results are unreasonable and the model needs to be modified and submitted for calculation again; if satisfied, it indicates that the calculation results are reasonable, and the maximum equivalent stress cloud map and value of the VHB strip can be further obtained, which is compared with the tensile test results of the VHB strip substrate. If the maximum equivalent stress value is greater than the positive tensile strength of the substrate, it indicates that the VHB strip is damaged and there is a risk of reduced bonding ability of the VHB strip.
[0040] The main principles and features of the present invention are described above. It should be understood that the above embodiments are only used to illustrate the implementation process of the present invention but not to limit the present invention. Therefore, any modifications and equivalent substitutions made to the present invention without departing from the spirit and scope of the present invention should be included in the protection scope of the present invention.
Claims
1. A simulation analysis method for the bonding strength of a vehicle central control screen, characterized in that: The following steps are involved: Import the 3D geometric model of the vehicle central control screen and clean up the model; Establish a finite element model of the vehicle central control panel subjected to impact load, and then export the K file; Edit the K file and select the contact algorithm to simulate the connection relationship between components; Submit the K file for calculation and solution, and obtain the vehicle energy curve after successful solution; The rationality of the calculation results is judged according to the vehicle energy curve. If the calculation results are reasonable, the maximum equivalent stress cloud diagram and value of the VHB rubber strip are further obtained, and compared with the tensile test results of the VHB rubber strip substrate to obtain the analysis results.
2. The method for simulating and analyzing the bonding strength of a vehicle central control screen according to claim 1, characterized in that: The model cleaning includes: Remove geometric features such as small chamfers, small fillets, small holes, and imprints, simplify non-focus components with complex external structures into solid bodies with regular shapes, and convert the extracted surfaces of sheet metal parts into shell elements.
3. The method for simulating and analyzing the bonding strength of a vehicle central control screen as claimed in claim 1, characterized in that: The establishment of a finite element model of the vehicle central control panel subjected to impact load specifically includes: selecting a material constitutive model to determine material parameters, dividing a mesh model, setting boundary conditions and loads, and setting solution control parameters.
4. The method for simulating and analyzing the bonding strength of a vehicle central control screen as claimed in claim 3, characterized in that: When establishing the finite element model of the vehicle central control panel subjected to impact load, the post-compensation method is used to optimize the compensation of the half-sine pulse, the loading curves of acceleration, velocity and displacement are determined by the integration method, and the time-acceleration curve is applied to the vehicle structure.
5. The method for simulating and analyzing the bonding strength of a vehicle central control screen according to claim 1, characterized in that: The contact algorithm is selected to simulate the connection relationship between components, specifically including: The surface-to-surface contact and single-surface contact algorithms are mainly used to simulate the binding and friction contact between components. At the same time, the node rigid body is used to simulate the connection relationship of the screws, and the special node set CONSTRAINED_EXTRA_NODES is used to simulate the contact between the flexible body and the rigid body.
6. The method for simulating and analyzing the bonding strength of a vehicle central control screen according to claim 1, characterized in that: The method also includes: in the process of calculating and solving the K file, if a calculation error is reported, adjustments are made based on the grid model, contact settings, and solution settings until the solution is successful.
7. The method for simulating and analyzing the bonding strength of a vehicle central control screen as claimed in claim 1, characterized in that: The rationality of the calculation result is judged, specifically, including: judging whether energy is conserved and whether the ratio of hourglass energy to internal energy is less than 10% based on the vehicle energy curve.
8. The method for simulating and analyzing the bonding strength of a vehicle central control screen as claimed in claim 1, characterized in that: The method also includes: if the rationality judgment of the calculation result does not meet the requirements, re-modifying the model and submitting the calculation.
9. A vehicle central control screen bonding strength simulation analysis method according to any one of claims 1 to 8, characterized in that: The method also includes: in the analysis results, if the maximum equivalent stress value is greater than the tensile strength of the substrate, it indicates that the VHB strip is damaged, the bonding ability of the VHB strip is reduced, and there is a risk of debonding.
Citation Information
Patent Citations
Packaged product fall simulation analysis method
CN107423485A
Method and device for testing ageing of cohesive force of car window
CN107818234A
Impact-resistant novel fiber metal laminate and preparation method thereof
CN109263184A
Method for checking structural strength of vehicle-mounted IVI product
CN112035944A
