A method for predicting deformation behavior in laser additive and subtractive manufacturing based on numerical simulation

Numerical simulation using finite element software predicts deformation behavior in additive and subtractive manufacturing, ensuring precision and preventing cracking by identifying high-stress areas.

CN117390925BActive Publication Date: 2024-12-03HARBIN INST OF TECH
View PDF 2 Cites 0 Cited by

Patent Information

Application Number
CN202311384139.6
Authority / Receiving Office
CN · China
Patent Type
Patents(China)
Current Assignee / Owner
Filing Date
2023-10-24
Publication Date
2024-12-03
Estimated Expiration
2043-10-24

AI Technical Summary

Technical Problem

Current methods for predicting deformation behavior in additive and subtractive composite manufacturing are inaccurate, leading to unstable stress changes, affecting dimensional accuracy, causing cracks, and increasing the risk of workpiece failure.

Method used

A method using numerical simulation with finite element software (Abaqus) to model, mesh, and analyze the manufacturing process, including setting material parameters, loads, and boundary conditions to predict residual stress and deformation.

Benefits of technology

Accurately predicts material deformation due to thermal and mechanical stress, guiding the manufacturing process to avoid low precision and cracking by identifying high-stress areas.

✦ Generated by Eureka AI based on patent content.

Smart Images

  • Figure CN117390925B_ABST
    Figure CN117390925B_ABST
Patent Text Reader

Abstract

A method for predicting deformation behavior in laser additive and subtractive manufacturing based on numerical simulation, relates to a method for predicting deformation behavior in laser additive and subtractive manufacturing. The purpose is to effectively control the deformation of metal materials in the additive and subtractive manufacturing process, and avoid low precision and cracking problems caused by excessive internal stress of the workpiece. The present invention obtains the final residual stress distribution of the additive and subtractive composite manufacturing samples and the stress change curve of each part over time, and marks the distribution area of ​​high yield stress as the most likely area to accurately predict the material deformation caused by excessive thermal stress and mechanical stress during the manufacturing process. The present invention can guide the manufacturing process, effectively control the deformation of metal materials in the additive and subtractive manufacturing process, and avoid low precision and cracking problems caused by excessive internal stress of the workpiece.
Need to check novelty before this filing date? Find Prior Art

Description

Technical Field

[0001] The present invention relates to the technical field of metal laser additive and subtractive manufacturing, and in particular to a method for predicting deformation behavior in laser additive and subtractive manufacturing based on numerical simulation. Background Art

[0002] Additive and subtractive composite manufacturing is a secondary development technology of CNC machine tools based on additive manufacturing technology. It not only has the advantages of additive manufacturing such as fast forming speed, high material utilization rate and easy forming of complex structures, but also has the advantages of high quality and high precision in mechanical processing. It can realize the continuous processing process of "deposition-finishing" of complex parts on the same equipment, and is one of the important means of overall forming of complex metal components.

[0003] However, in the process of additive and subtractive composite manufacturing, the steep temperature gradient caused by the additive manufacturing process inevitably produces large residual stress inside the component. Later, when the material is reduced, the coupling of thermal stress, structural stress, and milling force makes the stress distribution inside the component more complicated. The magnitude of stress is proportional to the deformation. Unstable stress changes will make the deformation behavior of the workpiece more difficult to predict, which not only affects the dimensional accuracy of the workpiece, but also easily generates cracks and causes cracking, which in turn leads to the failure of the workpiece. Under current technology, whether it is destructive or non-destructive method ([1] Liu Jinna, Xu Binshi, Wang Haidou, et al. Development trend of residual stress determination methods of materials [J]. Physical and chemical testing: physical part, 2013 (10): 6.) residual stress measurement cannot accurately predict the stress and deformation of additive and subtractive composite manufacturing samples, and the cost is high and the effect is poor. Summary of the invention

[0004] In order to effectively control the deformation of metal materials during additive and subtractive manufacturing and avoid low precision and cracking problems caused by excessive internal stress of the workpiece, the present invention proposes a deformation behavior prediction method for laser additive and subtractive composite manufacturing based on numerical simulation.

[0005] The deformation behavior prediction method of laser additive and subtractive hybrid manufacturing based on numerical simulation of the present invention is carried out according to the following steps:

[0006] Step 1: Use 3D modeling software to build models of samples that need additive and subtractive manufacturing and the shape of the milling cutter required for processing;

[0007] Step 2: Import the sample models of additive and subtractive manufacturing and the milling cutter model built in step 1 into the component module of the finite element software abaqus;

[0008] Step 3: Create material parameters for the sample models of additive and subtractive manufacturing in the property module of the finite element software abaqus, create and assign cross sections, and assign material parameters to the sample models;

[0009] Step 4: Assemble the milling cutter model and the sample models of additive and subtractive manufacturing into one model in the assembly module of the finite element software abaqus, and set the absolute zero and Boltzmann constant of the model;

[0010] Step 5: Use the mesh module of the finite element software abaqus to seed and mesh the milling cutter model and the sample models of additive and subtractive manufacturing;

[0011] Step 6: Set the analysis step of the additive manufacturing process using the birth-death element method in the analysis step module of the finite element software abaqus, turn on the geometric nonlinear option and set the time length according to the actual laser scanning speed;

[0012] Step 7: Create the load, boundary and predefined field of the sample model of additive and subtractive manufacturing in the load module of the finite element software abaqus; when creating the load in step 7, check the body heat flux and set the total energy Q of the heat source in joules; if the prepared sample has a substrate, fix the substrate in the corresponding position according to the actual processing environment in the boundary setting; set the predefined temperature field in the predefined field, the value is in degrees Celsius and is set to the ambient temperature during the actual additive process;

[0013] Step 8: Create the interaction between the additive and subtractive manufacturing models and the air in the interaction module of the finite element software abaqus, and set the corresponding emissivity of the additive and subtractive manufacturing sample materials;

[0014] Step 9: Create and submit a job in the job module of the finite element software abaqus to obtain the temperature field and stress field distribution data of additive and subtractive manufacturing samples;

[0015] Step 10: Create new predefined fields of temperature and stress in the load module of the finite element software abaqus, and import the temperature field and stress field data obtained in step 9;

[0016] Step 11: Adjust the position of the milling cutter in the assembly module of the finite element software abaqus to control the milling depth and milling direction;

[0017] Step 12: Continue to create boundary conditions for the milling cutter model in the load module;

[0018] The boundary conditions of the milling cutter model in step 12 include the rotation direction and rotation speed of the milling cutter; the rotation direction and rotation speed of the milling cutter are: clockwise rotation, rotation speed 1500r / min

[0019] Step 13: Edit the material parameters in the material manager of the property module of the finite element software abaqus, and keep other parameters unchanged;

[0020] Step 14: Create a new milling displacement analysis step in the analysis step module of the finite element software abaqus;

[0021] Step 15: Create a new milling job in the job module of the finite element software abaqus and submit it to obtain the final stress field distribution data of the additive and subtractive manufacturing samples;

[0022] Step 16: Find the area with high numerical stress distribution in the stress distribution data obtained in steps 9 and 15 as the potential deformation area of ​​the sample, so as to predict the deformation behavior of the workpiece in the process of additive and subtractive composite manufacturing by the size of the stress distribution.

[0023] The present invention can obtain the final residual stress distribution of additive and subtractive composite manufacturing samples and the stress-time curve of each part, and mark the distribution area where the stress value is higher than the maximum yield stress of the sample material. This area is the area where deformation behavior is most likely to occur. The present invention can accurately predict the material deformation caused by excessive thermal stress and mechanical stress during the manufacturing process, and use this to guide the manufacturing process. Effectively control the deformation of metal materials during additive and subtractive manufacturing processes to avoid low precision and cracking problems caused by excessive internal stress of the workpiece. BRIEF DESCRIPTION OF THE DRAWINGS

[0024] Figure 1 It is an additive model for GH4169 nickel-based alloy block;

[0025] Figure 2 Schematic diagram of mesh division for GH4169 nickel-based alloy bulk additive model;

[0026] Figure 3 It is an additive and subtractive material model for GH4169 nickel-based alloy block;

[0027] Figure 4 Schematic diagram of mesh division of GH4169 nickel-based alloy block additive and subtractive material model;

[0028] Figure 5 This is a schematic diagram of the Mises stress simulation calculation results of the GH4169 nickel-based alloy block material addition and subtraction model;

[0029] Figure 6 Schematic diagram of stress distribution of the additive manufacturing deformation behavior simulation model of GH4169 nickel-based alloy block sample: the area with higher stress in the figure corresponds to Figure 7 The deformation area marked in .

[0030] Figure 7This is the surface morphology of the sample after actual manufacturing of GH4169 nickel-based alloy (the marked area is the deformation area);

[0031] Figure 8 This is the stress variation curve extracted from the simulation model. DETAILED DESCRIPTION

[0032] The technical solution of the present invention is not limited to the specific implementation modes listed below, but also includes any reasonable combination of the specific implementation modes.

[0033] Specific implementation method 1: The deformation behavior prediction method of laser additive and subtractive hybrid manufacturing based on numerical simulation in this implementation is carried out according to the following steps:

[0034] Step 1: Use 3D modeling software to build models of samples that need additive and subtractive manufacturing and the shape of the milling cutter required for processing;

[0035] Step 2: Import the sample models of additive and subtractive manufacturing and the milling cutter model built in step 1 into the component module of the finite element software abaqus;

[0036] Step 3: Create material parameters for the sample models of additive and subtractive manufacturing in the property module of the finite element software abaqus, create and assign cross sections, and assign material parameters to the sample models;

[0037] Step 4: Assemble the milling cutter model and the sample models of additive and subtractive manufacturing into one model in the assembly module of the finite element software abaqus, and set the absolute zero and Boltzmann constant of the model;

[0038] Step 5: Use the mesh module of the finite element software abaqus to seed and mesh the milling cutter model and the sample models of additive and subtractive manufacturing;

[0039] Step 6: Set the analysis step of the additive manufacturing process using the birth-death element method in the analysis step module of the finite element software abaqus, turn on the geometric nonlinear option and set the time length according to the actual laser scanning speed;

[0040] Step 7: Create the load, boundary and predefined field of the sample model of additive and subtractive manufacturing in the load module of the finite element software abaqus; when creating the load in step 7, check the body heat flux and set the total energy Q of the heat source in joules; if the prepared sample has a substrate, fix the substrate in the corresponding position according to the actual processing environment in the boundary setting; set the predefined temperature field in the predefined field, the value is in degrees Celsius and is set to the ambient temperature during the actual additive process;

[0041] Step 8: Create the interaction between the additive and subtractive manufacturing models and the air in the interaction module of the finite element software abaqus, and set the corresponding emissivity of the additive and subtractive manufacturing sample materials;

[0042] Step 9: Create and submit a job in the job module of the finite element software abaqus to obtain the temperature field and stress field distribution data of additive and subtractive manufacturing samples;

[0043] Step 10: Create new predefined fields of temperature and stress in the load module of the finite element software abaqus, and import the temperature field and stress field data obtained in step 9;

[0044] Step 11: Adjust the position of the milling cutter in the assembly module of the finite element software abaqus to control the milling depth and milling direction;

[0045] Step 12: Continue to create boundary conditions for the milling cutter model in the load module;

[0046] The boundary conditions of the milling cutter model in step 12 include the rotation direction and rotation speed of the milling cutter; the rotation direction and rotation speed of the milling cutter are: clockwise rotation, rotation speed 1500r / min

[0047] Step 13: Edit the material parameters in the material manager of the property module of the finite element software abaqus, and keep other parameters unchanged;

[0048] Step 14: Create a new milling displacement analysis step in the analysis step module of the finite element software abaqus;

[0049] Step 15: Create a new milling job in the job module of the finite element software abaqus and submit it to obtain the final stress field distribution data of the additive and subtractive manufacturing samples;

[0050] Step 16: Find the area with high numerical stress distribution in the stress distribution data obtained in steps 9 and 15 as the potential deformation area of ​​the sample, so as to predict the deformation behavior of the workpiece in the process of additive and subtractive composite manufacturing by the size of the stress distribution.

[0051] This embodiment has the following beneficial effects:

[0052] This embodiment can obtain the final residual stress distribution of additive and subtractive composite manufacturing samples and the stress change curve of each part over time, and mark the distribution area where the stress value is higher than the maximum yield stress of the sample material. This area is the area where deformation behavior is most likely to occur. This embodiment can accurately predict the material deformation caused by excessive thermal stress and mechanical stress during the manufacturing process, and use this to guide the manufacturing process. Effectively control the deformation of metal materials during additive and subtractive manufacturing, and avoid low precision and cracking problems caused by excessive internal stress of the workpiece.

[0053] Specific implementation method 2: The difference between this implementation method and specific implementation method 1 is that the 3D modeling software described in step 1 is UnigraphicsNX.

[0054] Specific implementation method three: This implementation method is different from specific implementation methods one or two in that: the sample model of additive and subtractive manufacturing described in step one, as well as the establishment of the milling cutter model required for processing, are established using metric units.

[0055] Specific implementation method 4: This implementation method is different from any one of specific implementation methods 1 to 3 in that: Step 2 imports the sample models of additive and subtractive manufacturing, and the milling cutter model into the component module of the finite element software abaqus in the SAT file format.

[0056] Specific implementation mode 5: This implementation mode is different from any one of specific implementation modes 1 to 4 in that: the material parameters in step 3 include density, Young's modulus, Poisson's ratio, specific heat capacity, thermal conductivity and linear thermal expansion coefficient.

[0057] Specific implementation method 6: This implementation method is different from any one of specific implementation methods 1 to 5 in that: in step 4, the absolute zero temperature is -273.15°C and the Boltz constant is 0.0000000567.

[0058] Specific implementation method 7: The difference between this implementation method and any one of specific implementation methods 1 to 6 is that in step 5, the grid output type is set to temperature and displacement.

[0059] Specific implementation eight: This implementation differs from any one of specific implementations one to seven in that: the maximum incremental step of the analysis step of the additive manufacturing process described in step five is set to 20,000.

[0060] Specific implementation method 9: This implementation method is different from any one of specific implementation methods 1 to 8 in that: in step 13, when editing material parameters, check the Johnson-Cook damage and damage evolution options, check the inelastic heat share option, and reassign the edited material parameters to all cross-sections of the additive and subtractive manufacturing sample models.

[0061] Specific implementation method ten: The difference between this implementation method and specific implementation methods one to nine is that when creating the milling displacement analysis step in step fourteen, the displacement distance and feed speed of the milling cutter are set according to the actual processing parameters.

[0062] Embodiment 1:

[0063] The deformation behavior prediction method of laser additive and subtractive hybrid manufacturing based on numerical simulation in this embodiment is performed according to the following steps:

[0064] Step 1: Model the sample to be manufactured by additive and subtractive methods and the shape of the milling cutter required for processing using 3D modeling software; the 3D modeling software in step 1 is UnigraphicsNX; the sample model of additive and subtractive manufacturing and the milling cutter model required for processing in step 1 are established in metric units;

[0065] Step 2: Import the sample model of additive and subtractive manufacturing and the milling cutter model built in step 1 into the component module of the finite element software abaqus; Step 2: Import the sample model of additive and subtractive manufacturing and the milling cutter model into the component module of the finite element software abaqus in the SAT file format; Figure 1 It is an additive model for GH4169 nickel-based alloy block; Figure 3 It is an additive and subtractive material model for GH4169 nickel-based alloy block;

[0066] Step 3: Create material parameters of the sample model of additive and subtractive manufacturing in the property module of the finite element software abaqus, create and assign sections, and assign material parameters to the sample model; the material parameters in step 3 include density, Young's modulus, Poisson's ratio, specific heat capacity, thermal conductivity and linear thermal expansion coefficient; the material parameters of the GH4169 nickel-based alloy in this embodiment include: thermal conductivity: 11.4W / m / ℃; density: 8200kg / m 3 ; Young's modulus: 20.6Gpa; Poisson's ratio: 0.3; Specific heat capacity: 435J / kg / ℃; Thermal expansion coefficient: 0.0000112 1 / ℃;

[0067] Step 4: Assemble the milling cutter model and the sample models of additive and subtractive manufacturing into one model in the assembly module of the finite element software abaqus, and set the absolute zero and Boltzmann constant of the model; in step 4, the absolute zero is -273.15℃ and the Boltzmann constant is 0.0000000567;

[0068] Step 5: In the mesh module of the finite element software abaqus, the milling cutter model and the sample models of additive and subtractive manufacturing are seeded and meshed; in step 5, the mesh output type is set to temperature and displacement; Figure 2Schematic diagram of mesh division for GH4169 nickel-based alloy bulk additive model; Figure 4 Schematic diagram of mesh division of GH4169 nickel-based alloy block additive and subtractive material model;

[0069] Step 6: In the analysis step module of the finite element software abaqus, the analysis step of the additive manufacturing process is set using the birth-death unit method, the geometric nonlinear option is turned on and the time length is set according to the actual laser scanning speed; the maximum incremental step of the analysis step of the additive manufacturing process is set to 20000; the actual laser scanning speed of this embodiment is 10 mm / s;

[0070] Step 7: Create the load, boundary and predefined field of the sample model of additive and subtractive manufacturing in the load module of the finite element software abaqus; when creating the load in step 7, check the body heat flux and set the total energy Q of the heat source in joules; if the prepared sample has a substrate, fix the substrate in the corresponding position according to the actual processing environment in the boundary setting; set the predefined temperature field in the predefined field, the value is in degrees Celsius and is set to the ambient temperature during actual additive manufacturing; the total energy Q of the heat source in this embodiment is 2000J;

[0071] Step 8: Create the interaction between the additive and subtractive manufacturing models and the air in the interaction module of the finite element software abaqus, and set the corresponding emissivity of the additive and subtractive manufacturing sample materials; the emissivity of GH4169 nickel-based alloy is 0.87;

[0072] Step 9: Create and submit a job in the job module of the finite element software abaqus to obtain the temperature field and stress field distribution data of additive and subtractive manufacturing samples; Figure 6 Schematic diagram of stress distribution of the additive manufacturing deformation behavior simulation model of GH4169 nickel-based alloy block sample: the area with higher stress in the figure corresponds to Figure 7 The deformation area marked in .

[0073] Step 10: Create new predefined fields of temperature and stress in the load module of the finite element software abaqus, and import the temperature field and stress field data obtained in step 9;

[0074] Step 11: Adjust the position of the milling cutter in the assembly module of the finite element software abaqus to control the milling depth and milling direction;

[0075] Step 12: Continue to create boundary conditions for the milling cutter model in the load module;

[0076] The boundary conditions of the milling cutter model in step 12 include the rotation direction and rotation speed of the milling cutter; the rotation direction and rotation speed of the milling cutter are: clockwise rotation, rotation speed 1500r / min

[0077] Step 13: Edit the material parameters in the material manager of the property module of the finite element software abaqus, and keep other parameters unchanged; when editing the material parameters in step 13, check the Johnson-Cook damage and damage evolution options, check the inelastic heat share option, and reassign the edited material parameters to all sections of the additive and subtractive manufacturing sample models;

[0078] The d1 to d4 values ​​of Johnson-Cook damage and damage evolution of GH4169 in this example are 0.04, 0.75, -1.45, and 0.04, respectively, and the inelastic heat share is 90%;

[0079] Step 14: Create a new milling displacement analysis step in the analysis step module of the finite element software abaqus; when creating the milling displacement analysis step in step 14, set the displacement distance and feed speed of the milling cutter according to the actual processing parameters;

[0080] The displacement distance of the milling cutter set in this embodiment is 20cm, and the feed speed is 3mm / s;

[0081] Step 15: Create a new milling job in the job module of the finite element software abaqus and submit it to obtain the final stress field distribution data of the additive and subtractive manufacturing samples; Figure 5 This is a schematic diagram of the Mises stress simulation calculation results of the GH4169 nickel-based alloy block material addition and subtraction model; Figure 8 This is the stress variation curve extracted from the simulation model.

[0082] Step 16: Find the area with high numerical stress distribution in the stress distribution data obtained in steps 9 and 15 as the potential deformation area of ​​the sample, so as to predict the deformation behavior of the workpiece in the process of additive and subtractive composite manufacturing by the size of the stress distribution. Figure 7 This is the surface morphology of the sample after actual manufacturing of GH4169 nickel-based alloy (the marked area is the deformation area);

[0083] This embodiment can obtain the final residual stress distribution of the additive and subtractive composite manufacturing samples and the stress change curve of each part over time, and mark the distribution area where the stress value is higher than the maximum yield stress of the sample material. This area is the area where deformation behavior is most likely to occur. The present invention can accurately predict the material deformation caused by excessive thermal stress and mechanical stress during the manufacturing process, and use this to guide the manufacturing process. Effectively control the deformation of metal materials during additive and subtractive manufacturing processes to avoid low precision and cracking problems caused by excessive internal stress in the workpiece.

Claims

1. A method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation, characterized in that: The deformation behavior prediction method of laser additive and subtractive hybrid manufacturing based on numerical simulation is carried out in the following steps: Step 1: Use 3D modeling software to build models of samples that need additive and subtractive manufacturing and the shape of the milling cutter required for processing; Step 2: Import the sample models of additive and subtractive manufacturing and the milling cutter model built in step 1 into the component module of the finite element software abaqus; Step 3: Create material parameters for the sample models of additive and subtractive manufacturing in the property module of the finite element software abaqus, create and assign cross sections, and assign material parameters to the sample models; Step 4: Assemble the milling cutter model and the sample models of additive and subtractive manufacturing into one model in the assembly module of the finite element software abaqus, and set the absolute zero and Boltzmann constant of the model; Step 5: Use the mesh module of the finite element software abaqus to seed and mesh the milling cutter model and the sample models of additive and subtractive manufacturing; Step 6: Set the analysis step of the additive manufacturing process using the birth-death element method in the analysis step module of the finite element software abaqus, turn on the geometric nonlinearity option and set the time length according to the actual laser scanning speed; Step 7: Create the load, boundary and predefined field of the sample model of additive and subtractive manufacturing in the load module of the finite element software abaqus; when creating the load in step 7, check the body heat flux and set the total energy Q of the heat source in joules; if the prepared sample has a substrate, fix the substrate in the corresponding position according to the actual processing environment in the boundary setting; set the predefined temperature field in the predefined field, the value is in degrees Celsius and is set to the ambient temperature during the actual additive process; Step 8: Create the interaction between the additive and subtractive manufacturing models and the air in the interaction module of the finite element software abaqus, and set the corresponding emissivity of the additive and subtractive manufacturing sample materials; Step 9: Create and submit a job in the job module of the finite element software abaqus to obtain the temperature field and stress field distribution data of additive and subtractive manufacturing samples; Step 10: Create new predefined fields of temperature and stress in the load module of the finite element software abaqus, and import the temperature field and stress field data obtained in step 9; Step 11: Adjust the position of the milling cutter in the assembly module of the finite element software abaqus to control the milling depth and milling direction; Step 12: Continue to create boundary conditions for the milling cutter model in the load module; The boundary conditions of the milling cutter model in step 12 include the rotation direction and rotation speed of the milling cutter; the rotation direction and rotation speed of the milling cutter are: clockwise rotation, rotation speed 1500 r / min; Step 13: Edit the material parameters in the material manager of the property module of the finite element software abaqus, and keep other parameters unchanged; Step 14: Create a new milling displacement analysis step in the analysis step module of the finite element software abaqus; Step 15: Create a new milling job in the job module of the finite element software abaqus and submit it to obtain the final stress field distribution data of the additive and subtractive manufacturing samples; Step 16: Find the area with high numerical stress distribution in the stress distribution data obtained in steps 9 and 15 as the potential deformation area of ​​the sample, so as to predict the deformation behavior of the workpiece in the process of additive and subtractive composite manufacturing by the size of the stress distribution.

2. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: The 3D modeling software in step 1 is Unigraphics NX.

3. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: In step 1, the sample models of additive and subtractive manufacturing and the milling cutter model required for processing are established using metric units.

4. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: Step 2: Import the sample models of additive and subtractive manufacturing, as well as the milling cutter model into the component module of the finite element software abaqus in the SAT file format.

5. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: The material parameters in step 3 include density, Young's modulus, Poisson's ratio, specific heat capacity, thermal conductivity and linear thermal expansion coefficient.

6. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: In step 4, absolute zero is -273.15°C and the Boltzmann constant is 0.0000000567.

7. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: In step 5, the mesh output type is set to temperature and displacement.

8. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: The maximum incremental step of the analysis step of the additive manufacturing process described in step 6 is set to 20,000.

9. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: Step 13: When editing the material parameters, check the Johnson-Cook damage and damage evolution options, check the inelastic heat share option, and reassign the edited material parameters to all cross-sections of the additive and subtractive manufacturing sample models.

10. The method for predicting deformation behavior of laser additive and subtractive hybrid manufacturing based on numerical simulation according to claim 1, characterized in that: Step 14: When creating the milling displacement analysis step, set the displacement distance and feed speed of the milling cutter according to the actual processing parameters.

Citation Information

Patent Citations

  • Method for predicting deformation of additive manufacturing part

    CN108334692A

  • Method for predicting structural fracture and deformation in additive manufacturing process

    CN115795953A